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Use Hole Wizard Feature Data Object to Create Hole Wizard Feature Example (VBA)

This topic shows how to use an existing hole wizard feature data object to create another hole wizard feature.




' Preconditions: Model is open and contains the specified

'                hole wizard feature.


' Postconditions: New hole wizard feature based on existing

'                hole wizard feature is created on the selected

'                entities.



Option Explicit


Dim swApp As SldWorks.SldWorks

Dim swModel As SldWorks.ModelDoc2

Dim swModelDocExt As SldWorks.ModelDocExtension

Dim swSelMgr As SldWorks.SelectionMgr

Dim swWzdHole As SldWorks.WizardHoleFeatureData2

Dim swFeat As SldWorks.Feature

Dim swFeatMgr As SldWorks.FeatureManager

Dim boolstatus As Boolean


Sub main()


Set swApp = Application.SldWorks

Set swModel = swApp.ActiveDoc

Set swModelDocExt = swModel.Extension

Set swFeatMgr = swModel.FeatureManager

Set swSelMgr = swModel.SelectionManager


' Get an existing hole wizard feature data object

boolstatus = swModelDocExt.SelectByID2("CBORE for M20 Hex Head Bolt1", "BODYFEATURE", 0, 0, 0, False, 0, Nothing, 0)

Set swFeat = swSelMgr.GetSelectedObject5(1)

Set swWzdHole = swFeat.GetDefinition

swModel.ClearSelection2 True


Set swFeat = Nothing


' Select the reference entities to use to create the hole wizard feature

boolstatus = swModelDocExt.SelectByID2("", "FACE", 0.09000000000003, -0.01278177510699, 0.04695929736232, False, 0, Nothing, 0)

boolstatus = swModelDocExt.SelectByID2("", "VERTEX", -0.1, -0.077, 0, True, 2, Nothing, 0)

' Create the new hole wizard feature

Set swFeat = swFeatMgr.CreateFeature(swWzdHole)


End Sub

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