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Mirroring Sheet Metal Parts

When you mirror a sheet metal part, many of the bends are mirrored as well. The only bends that are not mirrored are those that are normal to and coincident to the mirror plane; those bends are extended.

You can also:
  • Mirror selected sheet metal features in the part
  • Create a second, mirrored sheet metal body in the part
  • Use the Insert > Mirror Part command to create a new part that is a mirror of the original part

To mirror a sheet metal part:

  1. In an existing sheet metal part, click Mirror Tool_Mirror_Features.gif on the Features toolbar, or click Insert > Pattern/Mirror > Mirror .

    shm_mirror.gif

    If a message appears that says sheet metal features cannot be mirrored individually, click OK.

  2. In the PropertyManager, select a plane of symmetry or a planar face as the Mirror Face/Plane PM_plane.gif. Use Select Other from the shortcut menu if necessary.

    shm_mirror2.gif

  3. Select a body as the Bodies to Mirror PM_solid_surface_bodies.gif.
  4. Under Options, click Merge solids.

    If you clear Merge solids, a second body that is the mirror of the original is created in the part.
    shm_mirror3.gif

  5. Click PM_OK.gif.

    The entire part is mirrored as well as the sheet metal bends.
    shm_mirror4.gif



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