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Thread PropertyManager

Specify the following properties when inserting a thread in a part.

To open the Thread PropertyManager:

  1. On a cylindrical feature (a boss, a cut, or a hole), select the circular edge where the thread begins.
  2. Click Thread (Features toolbar), or click Insert > Features > Thread .

Thread Location

select_edge_cir.png Edge of Cylinder Select a circular edge in the graphics area.
Optional Start Location Select a starting point for the helix such as a vertex (sketch, model, or reference points), edge (sketch, model or reference axis), plane, or planar surface. This selection is optional if the edge is a planar circular edge, but required, if not.
  Offset  
  Reverse Direction Flips the offset direction to the opposite side of the selected reference.
Start Angle Defines a starting location for the helix. The start angle must be positive. Enter a value or start with = (equal sign) to create an equation.

End Condition

Reverse Direction Select one of the following:

Blind

Specify a value for Depth. Terminates the thread at a specific distance from the starting location, taking into account any offset.

Revolutions

Terminates the helix a specific number of revolutions from the starting location, taking into account any offset. The value must be positive and greater than 0.00. Enter a value or start with = (equal sign) to create an equation.

Up to Selection

Select a vertex (sketch, model, or reference points), edge (sketch, model or reference axis), plane, or planar surface. A plane, planar face, or edge must be parallel to the circular edge (i.e. perpendicular to the thread axis).

  Maintain thread length Keeps the thread at a constant length from the start surface. Only displays if Surface Offset is set and End Condition is set to Blind or Revolutions.

Specification

  Type Select a thread type. Displays library part files installed in C:\ProgramData\SolidWorks\SOLIDWORKS YYYY\Thread Profiles.
  Size Select a thread size. Displays configurations in the library part file from the Type list.
Override Diameter Click to manually override the diameter of the cylindrical face or helix. Enter a value or start with = (equal sign) to create an equation.
Override Pitch Click to manually override the pitch of the helix. Enter a value or start with = (equal sign) to create an equation.
  Thread Method Select one of the following:

Cut Thread

Creates a swept cut using the profile.

Extrude Thread

Creates a swept boss using the profile.

  Mirror Profile Flips the profile of the helix about its horizontal axis or vertical axis. Select one of the following:

Mirror horizontally

Mirror vertically

Rotation Angle Rotates the helix by a set number of degrees. Enter a value or start with = (equal sign) to create an equation.
  Locate Profile Zooms to the profile so you can change any sketch points or vertices in the sketch profile.

Thread Options

  Right-hand thread Creates threads in a clockwise direction.
  Left-hand thread Creates threads in a counter clockwise direction.

Preview Options

  Shaded preview Displays a fully tessellated preview of the thread.
  Wireframe preview Displays a wireframe preview of the thread.
  Partial preview Adjusts the number of wires displayed in the wireframe.


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