Adding an Equation

You can add an equation to a part or assembly using the Equation View, Dimension View, or Ordered View.

1. Do one of the following:
   • Click Equations (Tools toolbar).
   • Click Tools > Equations.
   • Right-click the Equations folder in the FeatureManager design tree, and select Manage Equations.
2. Select the Equation View .
3. In the Equations section, click an empty cell in the Name column.
4. Click a dimension in the graphics area.
   The SOLIDWORKS software does the following:

   • Propagates the dimension name to an empty cell in the Name column and encloses it in quotation marks.
   • Moves the cursor to the Value/Equations column and inserts = (equal sign).
   • Displays a flyout menu with options for starting the equation.
5. After = (equal sign), add a term to the equation by doing one of the following:
   • Type a number or a conditional statement.
   • Select a Global Variable, Function or File Property from the flyout menu.
   • Select Measure ... from the flyout menu and use the Measure Tool to create the term.
   A appears in the cell to indicate that the syntax is valid.
6. Type + (plus), - (minus) or another mathematical symbol.
7. Add another term to the equation.
8. When the equation is complete, click .
   The solution to the equation appears in the Evaluates to column and the cursor moves to the next cell in the Comments column.
9. Add comments to document your design intent.
10. Click OK to close the dialog box.