Create and Edit Circular Sketch Pattern Example (C#)

This example shows how to create and edit a circular sketch pattern.

//------------------------------------------------------------
// Preconditions: Verify that the specified part document template
// exists.
//
// Postconditions:
// 1. Opens a new part document and creates a sketch.
// 2. Inserts a circular sketch pattern of four instances.
// 3. Closes the sketch.
// 4. Opens the circular sketch pattern for editing.
// 5. Deletes an instance of the circular sketch pattern, leaving
//    three instances.
// 6. Examine the graphics area.
//------------------------------------------------------------

using SolidWorks.Interop.sldworks;
using SolidWorks.Interop.swconst;
using System;
namespace Macro1CSharp.csproj
{
    partial class SolidWorksMacro

    {
        public void Main()

        {

            ModelDoc2 swModel = default(ModelDoc2);
            ModelDocExtension swModelDocExt = default(ModelDocExtension);
            SketchManager swSketchMgr = default(SketchManager);
            SketchSegment swSketchSegment = default(SketchSegment);
            object vSkLines = null;
            bool boolstatus = false;
            int longstatus = 0;

            // Reset the counts for untitled documents for this macro
            swApp.ResetUntitledCount(0, 0, 0);

            // Create a part document
            swModel = (ModelDoc2)swApp.NewDocument("C:\\ProgramData\\SOLIDWORKS\\SOLIDWORKS 2016\\templates\\Part.prtdot", 0, 0, 0);
            swApp.ActivateDoc2("Part1", false, ref longstatus);
            swModel = (ModelDoc2)swApp.ActiveDoc;
            swSketchMgr = swModel.SketchManager;
            swModelDocExt = swModel.Extension;

            // Sketch a circle
            swSketchSegment = swSketchMgr.CreateCircle(0.0, 0.0, 0.0, 0.045549, 0.013926, 0.0);

            // Clear any selections and change
            // the view orientation to Front
            swModel.ClearSelection2(true);
            swModel.ShowNamedView2("*Front", 1);

            // Create a rectangle
            vSkLines = swSketchMgr.CreateCornerRectangle(-0.005867589431389, 0.03694408160504, 0, 0.004563680668858, 0.02673012963188, 0);
            // Create a circular sketch pattern
            // using the rectangle
            boolstatus = swSketchMgr.CreateCircularSketchStepAndRepeat(0.03184378021964, 4.732863934409, 4, 1.570796326795, true, "", true, true, true);
            swModel.ClearSelection2(true);

            // Close the sketch and rebuild
            swSketchMgr.InsertSketch(true);

            // Select an entity in the circular sketch pattern
            // and open the circular sketch pattern to edit it
            boolstatus = swModelDocExt.SelectByID2("Line1@Sketch1", "EXTSKETCHSEGMENT", -0.002390499397973, 0.03694408160504, 0, false, 0, null, 0);

            swModel.EditSketch();

            // Delete an instance of the circular
            // sketch pattern and close the sketch
             boolstatus = swSketchMgr.EditCircularSketchStepAndRepeat(0.03184378021964, 4.732863934409, 3, 1.570796326795, true, "", true, true, true, "Line2_Line1_Line4_Line3_");

            swModel.ClearSelection2(true);

            swSketchMgr.InsertSketch(true);

        }

        public SldWorks swApp;

    }

}