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Dissolve Subassembly in a BOM Table Example (VBA)

This example shows how to dissolve and restore a subassembly in a BOM table.

' Preconditions:
' 1. Open install_dir\samples\tutorial\assemblyvisualize\food_processor.sldasm.
' 2. Select File > Make Drawing from Assembly.
' 3. Click OK.
' 4. Drag one or more views onto the drawing.
' 5. Ensure that the specified template exists.
' Postconditions:
' 1. Inserts an indented BOM table in the drawing.
' 2. Dissolves the blade shaft subassembly.
' 3. After the macro stops, press F5 to restore the blade
'    shaft subassembly.
' NOTE: Because this document is used by a SOLIDWORKS
' online tutorial, do not save any changes when
' closing it.
Dim swApp As SldWorks.SldWorks

Dim Part As SldWorks.ModelDoc2
Dim swModelDocExt           As SldWorks.ModelDocExtension
Dim swDrawing               As SldWorks.DrawingDoc
Dim swView                  As SldWorks.View
Dim boolstatus As Boolean
Dim swBOMAnnotation         As SldWorks.BomTableAnnotation
Dim AnchorType              As Long
Dim BomType                 As Long
Dim Configuration           As String
Dim TableTemplate           As String

Option Explicit
Sub main()

    Set swApp = Application.SldWorks
Set Part = swApp.ActiveDoc
    Set swDrawing = Part
    Set swModelDocExt = Part.Extension

    boolstatus = swDrawing.ActivateView("Drawing View1")
    Set swView = swDrawing.ActiveDrawingView

    AnchorType = swBOMConfigurationAnchor_TopLeft
    BomType = swBomType_Indented
    TableTemplate = "C:\Program Files\SOLIDWORKS Corp\SOLIDWORKS\lang\english\bom-standard.sldbomtbt"
    Configuration = ""
    Set swBOMAnnotation = swView.InsertBomTable4(False, 0.4, 0.3, AnchorType, BomType, Configuration, TableTemplate, False, swNumberingType_Detailed, True)

    'Dissolve blade shaft subassembly
    boolstatus = swBOMAnnotation.Dissolve(8)
    'Restore blade shaft subassembly
    boolstatus = swBOMAnnotation.RestoreRestructuredComponents(0)

End Sub


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