Get Mirror Solid Feature Data Example (C#)
This example shows how to get data for a mirror solid feature.
//------------------------------------------------------------------------------
// Preconditions:
// 1. Verify that the specified part document to open exists.
// 2. Open the Immediate window.
//
// Postconditions:
// 1. Opens the specified part document.
// 2. Selects a plane and solid body.
// 3. Mirrors the solid body.
// 4. Gets the mirror solid feature and some of its data.
// 5. Prints to the Immediate window some mirror solid feature data.
// 6. Examine the Immediate window, FeatureManager design tree, and graphics
// area.
//
// NOTE: Because the part is used elsewhere, do not save changes.
//-----------------------------------------------------------------------------
using SolidWorks.Interop.sldworks;
using SolidWorks.Interop.swconst;
using System.Runtime.InteropServices;
using System;
using System.Diagnostics;
namespace MirrorSolidFeatureDataCSharp.csproj
{
public partial class SolidWorksMacro
{
public void Main()
{
ModelDoc2 swModel = default(ModelDoc2);
ModelDocExtension swModelDocExt = default(ModelDocExtension);
FeatureManager swFeatureManager = default(FeatureManager);
Feature swFeature = default(Feature);
MirrorSolidFeatureData swMirrorSolidFeatureData = default(MirrorSolidFeatureData);
Body2 swBody = default(Body2);
SelectionMgr swSelectionMgr = default(SelectionMgr);
SelectData swSelData = default(SelectData);
bool status = false;
int errors = 0;
int warnings = 0;
string fileName = null;
int i = 0;
object[] bodies = null;
//Open part
fileName = "C:\\Program Files\\SolidWorks Corp\\SolidWorks\\samples\\tutorial\\multibody\\multi_inter.sldprt";
swModel = (ModelDoc2)swApp.OpenDoc6(fileName, (int)swDocumentTypes_e.swDocPART, (int)swOpenDocOptions_e.swOpenDocOptions_Silent, "", ref errors, ref warnings);
//Select plane and solid body
swModelDocExt = (ModelDocExtension)swModel.Extension;
status = swModelDocExt.SelectByID2("Top", "PLANE", 0, 0, 0, true, 0, null, 0);
status = swModelDocExt.SelectByID2("Extrude-Thin1", "SOLIDBODY", 0, 0, 0, true, 0, null, 0);
swModel.ClearSelection2(true);
status = swModelDocExt.SelectByID2("Top", "PLANE", 0, 0, 0, false, 2, null, 0);
status = swModelDocExt.SelectByID2("Extrude-Thin1", "SOLIDBODY", 0, 0, 0, true, 256, null, 0);
//Insert mirror solid feature
swFeatureManager = (FeatureManager)swModel.FeatureManager;
swFeature = (Feature)swFeatureManager.InsertMirrorFeature2(true, false, false, false, (int)swFeatureScope_e.swFeatureScope_AllBodies);
//Get mirror solid feature and some of its data
swMirrorSolidFeatureData = (MirrorSolidFeatureData)swFeature.GetDefinition();
Debug.Print(" " + swFeature.Name);
Debug.Print(" Number of bodies = " + swMirrorSolidFeatureData.GetPatternBodyCount());
Debug.Print(" Merged bodies = " + swMirrorSolidFeatureData.Merge);
Debug.Print(" Knit surfaces = " + swMirrorSolidFeatureData.KnitSurface);
//Roll back to get to the bodies
status = swMirrorSolidFeatureData.AccessSelections(swModel, null);
swSelectionMgr = (SelectionMgr)swModel.SelectionManager;
swSelData = (SelectData)swSelectionMgr.CreateSelectData();
bodies = (object[])swMirrorSolidFeatureData.PatternBodyArray;
for (i = 0; i < bodies.Length; i++)
{
swBody = (Body2)bodies[i];
status = swBody.Select(true, 0);
Debug.Print(" Body " + i + 1 + "'s type (solid body = 0) = " + swBody.GetType());
}
//Release selection access
swMirrorSolidFeatureData.ReleaseSelectionAccess();
}
/// <summary>
/// The SldWorks swApp variable is pre-assigned for you.
/// </summary>
public SldWorks swApp;
}
}