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Create Shell Feature Example (VBA)

This example shows how to create a shell feature.

'---------------------------------------------------------------------------
' Preconditions:
' 1. Verify that the specified model document exists.
' 2. Open an Immediate window.
'
' Postconditions:
' 1. Selects a face to remove from the model to create the shell.
' 2. Creates Shell1.
' 3. Inspect the Immediate window, graphics area, and
'    FeatureManager design tree.
'
' NOTE: Because the model is used elsewhere, do not save changes.
'----------------------------------------------------------------------------

Dim swApp                   As SldWorks.SldWorks
Dim swModel                 As SldWorks.ModelDoc2
Dim swSelMgr                As SldWorks.SelectionMgr
Dim swSelData               As SldWorks.SelectData
Dim swFeat                  As SldWorks.Feature
Dim swShell                 As SldWorks.ShellFeatureData
Dim vFaceRemArr             As Variant
Dim vFaceRem                As Variant
Dim swFaceRem               As SldWorks.Face2
Dim vMultiFaceArr           As Variant
Dim vMultiFace              As Variant
Dim swMultiFace             As SldWorks.Face2
Dim swEnt                   As SldWorks.Entity
Dim i                       As Long
Dim bRet                    As Boolean
Dim longstatus As Long, longwarnings As Long

Option Explicit

Sub main()

    Set swApp = Application.SldWorks
   

    Set swModel = swApp.OpenDoc6("C:\Program Files\SolidWorks Corp\SolidWorks\samples\tutorial\api\block20.sldprt", 1, 0, "", longstatus, longwarnings)
    swApp.ActivateDoc2 "block20", False, longstatus
    Set swModel = swApp.ActiveDoc
  

    bRet = swModel.Extension.SelectByID2("", "FACE", -1.50558029249623E-02, 3.96239999999466E-02, -0.018063862472502, False, 1, Nothing, 0)
    swModel.InsertFeatureShell 0.00254, False
   

    Set swSelMgr = swModel.SelectionManager
    Set swSelData = swSelMgr.CreateSelectData
    Set swFeat = swSelMgr.GetSelectedObject6(1, -1)
    Set swShell = swFeat.GetDefinition

    ' Get shell data
    Debug.Print "File = " & swModel.GetPathName
    Debug.Print "  " & swFeat.Name
    Debug.Print "    Direction: " & swShell.Direction
    Debug.Print "    Thickness: " & swShell.Thickness * 1000# & " mm"
    Debug.Print "    Count of faces removed: " & swShell.FacesRemovedCount
    Debug.Print "    Count of faces with alternative thicknesses: " & swShell.GetMultipleThicknessFacesCount

    bRet = swShell.AccessSelections(swModel, Nothing)
    swModel.ClearSelection2 True

    vFaceRemArr = swShell.FacesRemoved

    For Each vFaceRem In vFaceRemArr
        Set swFaceRem = vFaceRem
        Set swEnt = swFaceRem

        bRet = swEnt.Select4(True, swSelData)
    Next

    swModel.ClearSelection2 True
    vMultiFaceArr = swShell.MultipleThicknessFaces

    For Each vMultiFace In vMultiFaceArr
        Set swMultiFace = vMultiFace
        Set swEnt = swMultiFace

        Debug.Print "    Alternative thickness in mm at face (" & i & "): " & swShell.GetMultipleThicknessAtIndex(i) * 1000#
        i = i + 1

        bRet = swEnt.Select4(True, swSelData)
    Next

    swModel.ClearSelection2 True
    swShell.ReleaseSelectionAccess

   
End Sub



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