Insert Extruded Reference Surface Example (C#)

//----------------------------------------------------------------------------
// Preconditions:
// 1. Verify that the specified part template exists.
// 2. Open the Immediate window.
//
// Postconditions:
// 1. Creates Surface-Extrude1 in the FeatureManager design tree.
// 2. Expand the Surface Bodies folder to verify that it contains:
//    * Surface-Extrude[1]
//    * Surface-Extrude[2]
//    * Surface-Extrude[3]
// 3. Inspect the Immediate window.
//---------------------------------------------------------------------------
using Microsoft.VisualBasic;
using System;
using System.Collections;
using System.Collections.Generic;
using System.Data;
using System.Diagnostics;
using SolidWorks.Interop.sldworks;
using SolidWorks.Interop.swconst;
using System.Runtime.InteropServices;
namespace InsertExtrudedSurface_CSharp.csproj
{
    partial class SolidWorksMacro
    {
 
        ModelDoc2 Part;
        SelectionMgr selMgr;
        Feature surfExtrudeFeat;
        SurfExtrudeFeatureData surfExtrude;
        bool boolstatus;
        int longstatus;
 
        public void Main()
        {
            Part = (ModelDoc2)swApp.NewDocument("C:\\ProgramData\\SOLIDWORKS\\SOLIDWORKS 2016\\templates\\Part.prtdot", 0, 0, 0);
            swApp.ActivateDoc2("Part1", false, ref longstatus);
            Part = (ModelDoc2)swApp.ActiveDoc;
            ModelView myModelView = default(ModelView);
            myModelView = (ModelView)Part.ActiveView;
            myModelView.FrameState = (int)swWindowState_e.swWindowMaximized;
            Part.SketchManager.InsertSketch(true);
            boolstatus = Part.Extension.SelectByID2("Front Plane", "PLANE", -0.03891024234798, 0.02968528649877, 0.0003646590412283, false, 0, null, 0);
            Part.ClearSelection2(true);
            object vSkLines = null;
            vSkLines = Part.SketchManager.CreateCornerRectangle(-0.05517876768764, 0.008130204900836, 0, -0.02399076855985, -0.0155939995639, 0);
            Part.ClearSelection2(true);
            vSkLines = Part.SketchManager.CreateCornerRectangle(-0.003731897331531, 0.008130204900836, 0, 0.0285223581767, -0.02998846069981, 0);
            Part.ClearSelection2(true);
            SketchSegment skSegment = default(SketchSegment);
            skSegment = Part.SketchManager.CreateCircle(0.053579, 0.013995, 0.0, 0.06819, 0.018462, 0.0);
            Part.ClearSelection2(true);
            Part.SketchManager.InsertSketch(true);
            Part.ShowNamedView2("*Trimetric", 8);
            Part.ClearSelection2(true);
            boolstatus = Part.Extension.SelectByID2("Sketch1", "SKETCH", 0, 0, 0, false, 0, null, 0);
 
            FeatureManager myFeatMr = default(FeatureManager);
            myFeatMr = Part.FeatureManager;
 
            // Create a blind surface extrude of 10 mm 
            // in two directions from the selected sketch 
            // in a direction normal to the selected sketch plane
            myFeatMr.FeatureExtruRefSurface2(false, false, false, 0, 0, 0.01, 0.01, false, false, false,
            false, 0.01745329251994, 0.01745329251994, false, false, false, false, false, false, false,
            false);
 
            Part.ClearSelection2(true);
            selMgr = (SelectionMgr)Part.SelectionManager;
 
            // Get Surface-Extrude1 data
            boolstatus = Part.Extension.SelectByID2("Surface-Extrude1", "BODYFEATURE", 0, 0, 0, false, 0, null, 0);
 
            surfExtrudeFeat = (Feature)selMgr.GetSelectedObject6(1, -1);
            surfExtrude = (SurfExtrudeFeatureData)surfExtrudeFeat.GetDefinition();
 
            surfExtrude.AccessSelections(Part, null);
 
            Debug.Print(surfExtrudeFeat.Name);
            Debug.Print("  Depth:");
            Debug.Print("    Forward direction: " + surfExtrude.GetDepth(true));
            Debug.Print("    Reverse direction: " + surfExtrude.GetDepth(false));
            Debug.Print("  End condition as defined in swSurfaceExtendEndCond_e:");
            Debug.Print("    Forward direction: " + surfExtrude.GetEndCondition(true));
            Debug.Print("    Reverse direction: " + surfExtrude.GetEndCondition(false));
            Debug.Print("  Reverse offset enabled:");
            Debug.Print("    Forward direction? " + surfExtrude.GetReverseOffset(true));
            Debug.Print("    Reverse direction? " + surfExtrude.GetReverseOffset(false));
            Debug.Print("  Translate surface setting enabled:");
            Debug.Print("    Forward direction? " + surfExtrude.GetTranslateSurface(true));
            Debug.Print("    Reverse direction? " + surfExtrude.GetTranslateSurface(false));
            Debug.Print("  Surface extruded in both directions? " + surfExtrude.BothDirections);
            Debug.Print("  Extrusion reversed? " + surfExtrude.ReverseDirection);
 
            surfExtrude.ReleaseSelectionAccess();
 
        }
 
 
        public SldWorks swApp;
 
    }
}