Hide Table of Contents

Insert GTol Example (VB.NET)

This example shows how to insert a GTol.
 

'----------------------------------------------------------------------------
' Preconditions: Verify that the specified drawing document exists.
'
' Postconditions:
' 1. Opens the specified drawing document.
' 2. Inserts a GTol whose first frame contains a geometric tolerance
'    position symbol referencing the specified combination of datums and
'    material conditions.
' 3. Examine the drawing.
'
' NOTE: Because the drawing is used elsewhere, do not save changes.
'---------------------------------------------------------------------------
Imports SolidWorks.Interop.sldworks
Imports SolidWorks.Interop.swconst
Imports System.Runtime.InteropServices
Imports System
 
Partial Class SolidWorksMacro
 
    Dim swDrawing As DrawingDoc
    Dim swModel As ModelDoc2
    Dim myGtol As Gtol
    Dim myAnno As Annotation
    Dim status As Boolean
    Dim errors As Integer
    Dim warnings As Integer
    Dim fileName As String
    Sub main()
 
        fileName = "C:\Program Files\SolidWorks Corp\SOLIDWORKS\samples\tutorial\advdrawings\foodprocessor.slddrw"
        swDrawing = swApp.OpenDoc6(fileName, swDocumentTypes_e.swDocDRAWING, swOpenDocOptions_e.swOpenDocOptions_Silent, "", errors, warnings)
        swApp.ActivateDoc3("foodprocessor - Sheet1"False, swRebuildOnActivation_e.swRebuildActiveDoc, errors)
        swModel = swDrawing
 
        myGtol = swModel.InsertGtol()
        If Not myGtol Is Nothing Then
            myGtol.SetFrameSymbols2(1, "<IGTOL-POSI>"False""False"""""""")
            status = myGtol.SetFrameValues2(1, "0.4""""B-A-C<MOD-MMC>""B<MOD-MMC>-C<MOD-LMC>""C<MOD-MMC>-A")
            myGtol.SetPTZHeight(""False)
            myGtol.SetBetweenTwoPoints(False"""")
            myAnno = myGtol.GetAnnotation()
            If Not myAnno Is Nothing Then
                status = myAnno.SetPosition(0.319315975204224, 0.12666668401487, 0)
                errors = myAnno.SetLeader3(swLeaderStyle_e.swNO_LEADER, 0, TrueFalseFalseFalse)
            End If
        End If
        swModel.WindowRedraw()
 
    End Sub
 
 
    ''' <summary>
    ''' The SldWorks swApp variable is pre-assigned for you.
    ''' </summary>
    Public swApp As SldWorks
 
 
End Class
 



Provide feedback on this topic

SOLIDWORKS welcomes your feedback concerning the presentation, accuracy, and thoroughness of the documentation. Use the form below to send your comments and suggestions about this topic directly to our documentation team. The documentation team cannot answer technical support questions. Click here for information about technical support.

* Required

 
*Email:  
Subject:   Feedback on Help Topics
Page:   Insert GTol Example (VB.NET)
*Comment:  
*   I acknowledge I have read and I hereby accept the privacy policy under which my Personal Data will be used by Dassault Systèmes

Print Topic

Select the scope of content to print:



x

We have detected you are using a browser version older than Internet Explorer 7. For optimized display, we suggest upgrading your browser to Internet Explorer 7 or newer.

 Never show this message again
x

Web Help Content Version: API Help (English only) 2016 SP05

To disable Web help from within SOLIDWORKS and use local help instead, click Help > Use SOLIDWORKS Web Help.

To report problems encountered with the Web help interface and search, contact your local support representative. To provide feedback on individual help topics, use the “Feedback on this topic” link on the individual topic page.