Set Bodies for Move/Copy Example (C#)
This example shows how to set a body for a move/copy.
//---------------------------------------------------------------------
// Preconditions:
// 1. Verify that the specified part document exists.
// 2. Open the Immediate window.
//
// Postconditions:
// 1. Opens the specified part document.
// 2. Selects a solid body and two vertices.
// 3. Inserts a move/copy body feature.
// 4. Sets the body to move, copy, or rotate.
// 5. Examine the FeatureManager design tree, the graphics area, and
// the Immediate window.
//
// NOTE: Because the part is used elsewhere, do not save changes.
//---------------------------------------------------------------------
using SolidWorks.Interop.sldworks;
using SolidWorks.Interop.swconst;
using System.Runtime.InteropServices;
using System;
using System.Diagnostics;
using System.Collections;
namespace Macro1CSharp.csproj
{
public partial class SolidWorksMacro
{
public void Main()
{
ModelDoc2 swModel = default(ModelDoc2);
PartDoc swPart = default(PartDoc);
ModelDocExtension swModelDocExt = default(ModelDocExtension);
FeatureManager swFeatureManager = default(FeatureManager);
Feature swFeature = default(Feature);
MoveCopyBodyFeatureData swMoveCopyBodyFeatureData = default(MoveCopyBodyFeatureData);
SelectionMgr swSelectionMgr = default(SelectionMgr);
bool status = false;
int errors = 0;
int warnings = 0;
string fileName = null;
object[] bodyArr = new object[1];
Body2 aBody = default(Body2);
//Open part document
fileName = "C:\\Program Files\\SolidWorks Corp\\SolidWorks\\samples\\tutorial\\multibody\\multi_inter.sldprt";
swModel = (ModelDoc2)swApp.OpenDoc6(fileName, (int)swDocumentTypes_e.swDocPART, (int)swOpenDocOptions_e.swOpenDocOptions_Silent, "", ref errors, ref warnings);
swModelDocExt = (ModelDocExtension)swModel.Extension;
swFeatureManager = (FeatureManager)swModel.FeatureManager;
swSelectionMgr = (SelectionMgr)swModel.SelectionManager;
swPart = (PartDoc)swModel;
//Select solid body and vertices for move/copy body feature
status = swModelDocExt.SelectByID2("Extrude-Thin1", "SOLIDBODY", 0, 0, 0, true, 0, null, 0);
status = swModelDocExt.SelectByID2("", "VERTEX", -0.085, 0, 0.065, true, 0, null, 0);
status = swModelDocExt.SelectByID2("", "VERTEX", -0.085, -0.09, 0.065, true, 0, null, 0);
swModel.ClearSelection2(true);
status = swModelDocExt.SelectByID2("Extrude-Thin1", "SOLIDBODY", 0, 0, 0, false, 1, null, 0);
status = swModelDocExt.SelectByID2("", "VERTEX", -0.085, 0, 0.065, true, 4, null, 0);
status = swModelDocExt.SelectByID2("", "VERTEX", -0.085, -0.09, 0.065, true, 8, null, 0);
//Insert move/copy body feature
swFeature = (Feature)swFeatureManager.InsertMoveCopyBody2(0, 0, 0, 0, -0.085, 0, 0.065, 0, 0, 0,
true, 1);
swFeature = (Feature)swPart.FeatureByName("Body-Move/Copy1");
//Roll forward the feature and get and set move/copy body feature data
swMoveCopyBodyFeatureData = (MoveCopyBodyFeatureData)swFeature.GetDefinition();
status = swMoveCopyBodyFeatureData.AccessSelections(swModel, null);
//Get the body to set
status = swModelDocExt.SelectByID2("Extrude-Thin1", "SOLIDBODY", 0, 0, 0, false, 0, null, (int)swSelectOption_e.swSelectOptionDefault);
bodyArr[0] = (object)swSelectionMgr.GetSelectedObject6(1, -1);
swModel.ClearSelection2(true);
swMoveCopyBodyFeatureData.Bodies = bodyArr[0];
if ((bodyArr == null))
{
Debug.Print("Body not set.");
}
else
{
Debug.Print("Body set.");
aBody = (Body2)bodyArr[0];
Debug.Print("Name of body set: " + aBody.Name);
}
//Roll back the feature
swMoveCopyBodyFeatureData.ReleaseSelectionAccess();
swModel.ViewZoomtofit2();
}
/// <summary>
/// The SldWorks swApp variable is pre-assigned for you.
/// </summary>
public SldWorks swApp;
}
}