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Make Assembly From Selected Components Example (VB.NET)

This example shows how to make a new assembly using the selected components of the active assembly.

' Preconditions:
' 1. Open install_dir\samples\tutorial\motionstudies\valve_cam2.sldasm
' 2. Ensure that the Save new components to external files check box
'    on the Tools > Options > Assemblies dialog is selected.
'    Otherwise, the selected components are saved as virtual components
'    and not as external files.
' 3. Select valve<1> and valve_guide<1> components.
' Postconditions:
' 1. Creates install_dir\samples\tutorial\motionstudies\MyTestValveAssembly.sldasm,
'    which is made up of the valve<1> and valve_guide<1> components.
' 2. Replaces the valve<1> and valve_guide<1> components with
'    MyTestValveAssembly subassembly.
' 3. Examine the FeatureManager design tree and
'    install_dir\samples\tutorial\motionstudies.
' 4. Clear the Save new components to external files check box
'    on the Tools > Options > Assemblies dialog if you selected
'    it for this example.
' NOTE: Because the assembly is used elsewhere, do not save changes.

Imports SolidWorks.Interop.sldworks

Imports SolidWorks.Interop.swconst

Imports System


Partial Class SolidWorksMacro


    Public Sub main()


        Dim swModel As ModelDoc2

        Dim swAssy As AssemblyDoc

        Dim tmpPath As String

        Dim boolstat As Boolean


        swModel = swApp.ActiveDoc


        boolstat = True

        Dim strCompModelname As String

        strCompModelname = "MyTestValveAssembly.sldasm"


        ' Save the new assembly in the same folder as the original assembly

        tmpPath = Left(swModel.GetPathName, InStrRev(swModel.GetPathName, "\"))


        swAssy = swModel


        ' Create a new assembly using the selected components

        swAssy.MakeAssemblyFromSelectedComponents(tmpPath + strCompModelname)


    End Sub


    ''' <summary>

    ''' The SldWorks swApp variable is pre-assigned for you.

    ''' </summary>

    Public swApp As SldWorks


End Class

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