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Add Auto Balloons to Drawing Example (VB.NET)

This example shows how to automatically add BOM balloons to a drawing view.

'------------------------------------------------------------------------------
' Preconditions: Open a drawing with a bill of materials (BOM) table.
'
' Postconditions: BOM balloons are added to the view.
'------------------------------------------------------------------------------
Imports SolidWorks.Interop.sldworks
Imports SolidWorks.Interop.swconst
Imports System.Runtime.InteropServices
Imports System

Partial Class SolidWorksMacro

    
Dim Part As ModelDoc2
    
Dim vNotes As Object
    Dim autoballoonParams As AutoBalloonOptions
    
Dim boolstatus As Boolean

    Sub main()

        Part = swApp.ActiveDoc
        boolstatus = Part.ActivateView(
"Drawing View1")
        boolstatus = Part.Extension.SelectByID2(
"Drawing View1", "DRAWINGVIEW", 0, 0, 0, False, 0, Nothing, 0)

        autoballoonParams = Part.CreateAutoBalloonOptions()
        autoballoonParams.Layout = swBalloonLayoutType_e.swDetailingBalloonLayout_Square
        autoballoonParams.ReverseDirection =
False
        autoballoonParams.IgnoreMultiple = True
        autoballoonParams.InsertMagneticLine = True
        autoballoonParams.LeaderAttachmentToFaces = True
        autoballoonParams.Style = swBalloonStyle_e.swBS_Circular
        autoballoonParams.Size = swBalloonFit_e.swBF_5Chars
        autoballoonParams.UpperTextContent = swBalloonTextContent_e.swBalloonTextItemNumber
        autoballoonParams.Layername = "-None-"
        autoballoonParams.ItemNumberStart = 1
        autoballoonParams.ItemNumberIncrement = 1
        autoballoonParams.ItemOrder = swBalloonItemNumbersOrder_e.swBalloonItemNumbers_DoNotChangeItemNumbers
        autoballoonParams.EditBalloons =
True
        autoballoonParams.EditBalloonOption = swEditBalloonOption_Resequence

        vNotes = Part.AutoBalloon5(autoballoonParams)

    
End Sub


    
Public swApp As SldWorks


End Class



 



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