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Create Shell Feature Example (VB.NET)

This example shows how to create a shell feature..

'---------------------------------------------------------------------------
' Preconditions:
' 1. Verify that the specified model document exists.
' 2. Open an Immediate window.
'
' Postconditions:
' 1. Selects a face to remove from the model to create the shell.
' 2. Creates Shell1.
' 3. Inspect the Immediate window, graphics area, and
'    FeatureManager design tree.
'
' NOTE: Because the model is used elsewhere, do not save changes.
'----------------------------------------------------------------------------
Imports SolidWorks.Interop.sldworks
Imports SolidWorks.Interop.swconst
Imports System.Runtime.InteropServices
Imports System
Imports System.Diagnostics
 
 
Partial Class SolidWorksMacro
 
 
    Dim swModel As ModelDoc2
    Dim swSelMgr As SelectionMgr
    Dim swSelData As SelectData
    Dim swFeat As Feature
    Dim swShell As ShellFeatureData
    Dim vFaceRemArr As Object
    Dim vFaceRem As Object
    Dim swFaceRem As Face2
    Dim vMultiFaceArr As Object
    Dim vMultiFace As Object
    Dim swMultiFace As Face2
    Dim swEnt As Entity
    Dim i As Integer
    Dim bRet As Boolean
    Dim longstatus As Integer, longwarnings As Integer
 
 
    Sub main()
 
        swModel = swApp.OpenDoc6("C:\Users\Public\Documents\SOLIDWORKS\SOLIDWORKS 2017\tutorial\api\block20.sldprt", 1, 0, "", longstatus, longwarnings)
        swApp.ActivateDoc2("block20"False, longstatus)
        swModel = swApp.ActiveDoc
 
        bRet = swModel.Extension.SelectByID2("""FACE", -0.0150558029249623, 0.0396239999999466, -0.018063862472502, False, 1, Nothing, 0)
        swModel.InsertFeatureShell(0.00254, False)
 
        swSelMgr = swModel.SelectionManager
        swSelData = swSelMgr.CreateSelectData
        swFeat = swSelMgr.GetSelectedObject6(1, -1)
        swShell = swFeat.GetDefinition
 
        ' Get shell data
        Debug.Print("File = " & swModel.GetPathName)
        Debug.Print("  " & swFeat.Name)
        Debug.Print("    Direction: " & swShell.Direction)
        Debug.Print("    Thickness: " & swShell.Thickness * 1000.0# & " mm")
        Debug.Print("    Count of faces removed: " & swShell.FacesRemovedCount)
        Debug.Print("    Count of faces with alternative thicknesses: " & swShell.GetMultipleThicknessFacesCount)
 
        bRet = swShell.AccessSelections(swModel, Nothing)
        swModel.ClearSelection2(True)
 
        vFaceRemArr = swShell.FacesRemoved
 
        For Each vFaceRem In vFaceRemArr
            swFaceRem = vFaceRem
            swEnt = swFaceRem
 
            bRet = swEnt.Select4(True, swSelData)
        Next
 
        swModel.ClearSelection2(True)
        vMultiFaceArr = swShell.MultipleThicknessFaces
 
        For Each vMultiFace In vMultiFaceArr
            swMultiFace = vMultiFace
            swEnt = swMultiFace
 
            Debug.Print("    Alternative thickness in mm at face (" & i & "): " & swShell.GetMultipleThicknessAtIndex(i) * 1000.0#)
            i = i + 1
 
            bRet = swEnt.Select4(True, swSelData)
        Next
 
        swModel.ClearSelection2(True)
        swShell.ReleaseSelectionAccess()
 
 
    End Sub
 
    ''' <summary>
    ''' The SldWorks swApp variable is pre-assigned for you.
    ''' </summary>
    Public swApp As SldWorks
 
 
End Class
 

 

 



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