Hide Table of Contents

Get Preselected Object Example (VBA)

This example shows how to  get a preselected object when a preselection event is fired.

'-----------------------------------------------------------
' Preconditions:
' 1. Open a part, assembly, or drawing.
' 2. In the SOLIDWORKS Visual Basic IDE:
'    a. Copy and paste Main into the macro's main module.
'    b. Click Insert > Class Module and copy and paste
'       Class1 into that module.
'    c. Click Insert > Class Module and copy and paste
'       Class2 into that module.
'    d. Click Insert > Class Module and copy and paste
'       Class3 into that module.
' 3. If a part or assembly document is active, then
'    preselect (mouse over) a face.
'    - or -
'    If a drawing document is active, then preselect
'    an edge.
' 4. Open the Immediate window.
'
' Postconditions:
' 1. When a face is preselected in a part or assembly
'    document, or an edge is preselected in a drawing document,
'    then that interface's UserSelectionPreNotify event is fired.
' 2. In the SOLIDWORKS Visual Basic IDE, click Run > Reset to 
'    stop running the macro.
' 3. Examine the Immediate window.
'-----------------------------------------------------------
' Main
Option Explicit
Dim swApp As SldWorks.SldWorks
Dim swModel As SldWorks.ModelDoc2
Dim partDoc As New Class1
Dim assemblyDoc As New Class2
Dim drawingDoc As New Class3
Sub main()
    Set swApp = Application.SldWorks
    Set swModel = swApp.ActiveDoc    
    ' Determine the document type, then
    ' execute its corresponding class module
    If swModel.GetType = swDocPART Then
        partDoc.init swModel
    ElseIf swModel.GetType = swDocASSEMBLY Then
        assemblyDoc.init swModel
    ElseIf swModel.GetType = swDocDRAWING Then
        drawingDoc.init swModel
    End If
End Sub
'Class1
Public WithEvents doc As partDoc
Public Function init(ByRef docIn As Object)
    Set doc = docIn
End Function
Private Function doc_UserSelectionPreNotify(ByVal SelectionType As Long) As Long
    If SelectionType = swSelFACES Then
        Set swApp = Application.SldWorks
        Set swModel = swApp.ActiveDoc
        Dim swSelMgr As SldWorks.SelectionMgr
        Dim SelectedObject As Object
        Dim swFace As SldWorks.Face2
        Dim swFeature As SldWorks.Feature
        Set swSelMgr = swModel.SelectionManager
        Set SelectedObject = swSelMgr.GetPreSelectedObject
        If SelectionType = swSelFACES Then
            Set swFace = SelectedObject
            Set swFeature = swFace.GetFeature
            Debug.Print "Name of feature whose face you preselected: " & swFeature.Name
            Debug.Print "   Select a different face, or in the IDE to stop running the macro, click Run > Reset"
            Debug.Print " "
        End If
    End If
End Function
'Class2
Public WithEvents doc As assemblyDoc
Public Function init(ByRef docIn As Object)
    Set doc = docIn
End Function
Private Function doc_UserSelectionPreNotify(ByVal SelectionType As Long) As Long
        Set swApp = Application.SldWorks
        Set swModel = swApp.ActiveDoc
        Dim swSelMgr As SldWorks.SelectionMgr
        Dim SelectedObject As Object
        Dim swFace As SldWorks.Face2
        Dim swFeature As SldWorks.Feature
        Set swSelMgr = swModel.SelectionManager
        Set SelectedObject = swSelMgr.GetPreSelectedObject
        If SelectionType = swSelFACES Then
            Set swFace = SelectedObject
            Set swFeature = swFace.GetFeature
            Debug.Print "Name of feature whose face you preselected: " & swFeature.Name
            Debug.Print "   Select a different face, or in the IDE to stop running the macro, click Run > Reset"
            Debug.Print " "
        End If
End Function
'Class3
Public WithEvents doc As drawingDoc
Public Function init(ByRef docIn As Object)
    Set doc = docIn
End Function
Private Function doc_UserSelectionPreNotify(ByVal SelectionType As Long) As Long
        If SelectionType = swSelEDGES Then
            Set swApp = Application.SldWorks
            Set swModel = swApp.ActiveDoc
            Dim swSelMgr As SldWorks.SelectionMgr
            Dim SelectedObject As Object
            Dim swEdge As SldWorks.Edge
            Dim swBody As SldWorks.Body2
            Set swSelMgr = swModel.SelectionManager
            Set SelectedObject = swSelMgr.GetPreSelectedObject
            If SelectionType = swSelEDGES Then
                Set swEdge = SelectedObject
                Set swBody = swEdge.GetBody
                Debug.Print "Name of body whose edge you preselected: " & swBody.Name
                Debug.Print "   Select a different edge, or in the IDE to stop running the macro, click Run > Reset"
                Debug.Print " "
            End If
        End If
End Function


Provide feedback on this topic

SOLIDWORKS welcomes your feedback concerning the presentation, accuracy, and thoroughness of the documentation. Use the form below to send your comments and suggestions about this topic directly to our documentation team. The documentation team cannot answer technical support questions. Click here for information about technical support.

* Required

 
*Email:  
Subject:   Feedback on Help Topics
Page:   Get Preselected Object Example (VBA)
*Comment:  
*   I acknowledge I have read and I hereby accept the privacy policy under which my Personal Data will be used by Dassault Systèmes

Print Topic

Select the scope of content to print:




x

We have detected you are using a browser version older than Internet Explorer 7. For optimized display, we suggest upgrading your browser to Internet Explorer 7 or newer.

 Never show this message again
x

Web Help Content Version: API Help (English only) 2017 SP05

To disable Web help from within SOLIDWORKS and use local help instead, click Help > Use SOLIDWORKS Web Help.

To report problems encountered with the Web help interface and search, contact your local support representative. To provide feedback on individual help topics, use the “Feedback on this topic” link on the individual topic page.