Get Projected Curve Feature Data Example (C#)
This example shows how to get data for a projected curve feature.
//--------------------------------------------------------------
// Preconditions:
// 1. Verify that the part document exists.
// 2. Open the Immediate window.
//
// Postconditions:
// 1. Opens the specified part document.
// 2. Selects a face and sketches a spline on that face.
// 3. Selects the sketch of the spline and a face.
// 4. Inserts a projected curve feature.
// 5. Gets some projected curve feature data and prints it
// to the Immediate window.
// 6. Examine the Immediate window, FeatureManager design tree, and
// the graphics area.
//
// NOTE: Because the part is used elsewhere, do not save changes.
//----------------------------------------------------------------
using SolidWorks.Interop.sldworks;
using SolidWorks.Interop.swconst;
using System.Runtime.InteropServices;
using System;
using System.Diagnostics;
namespace ProjectCurveCSharp.csproj
{
public partial class SolidWorksMacro
{
public void Main()
{
ModelDoc2 swModel = default(ModelDoc2);
ModelDocExtension swModelDocExt = default(ModelDocExtension);
SketchManager swSketchManager = default(SketchManager);
SketchSegment swSketchSegment = default(SketchSegment);
Feature swFeature = default(Feature);
SelectionMgr swSelectionManager = default(SelectionMgr);
ProjectionCurveFeatureData swProjectionCurveFeatureData = default(ProjectionCurveFeatureData);
Sketch swSketch = default(Sketch);
object pointArray = null;
double[] points = new double[11];
bool status = false;
int errors = 0;
int warnings = 0;
string fileName = null;
//Open part document
fileName = "C:\\Users\\Public\\Documents\\SOLIDWORKS\\SOLIDWORKS 2017\\tutorial\\api\\block20.sldprt";
swModel = (ModelDoc2)swApp.OpenDoc6(fileName, (int)swDocumentTypes_e.swDocPART, (int)swOpenDocOptions_e.swOpenDocOptions_Silent, "", ref errors, ref warnings);
//Sketch a spline on the selected face
swModelDocExt = (ModelDocExtension)swModel.Extension;
status = swModelDocExt.SelectByID2("", "FACE", -0.0499223104334874, 0.0396239999998897, 0.00738137362270663, false, 0, null, 0);
swSketchManager = (SketchManager)swModel.SketchManager;
swSketchManager.InsertSketch(true);
swModel.ClearSelection2(true);
points[0] = -0.0624778997860176;
points[1] = 0.00729572078180673;
points[2] = 0;
points[3] = -0.0364588790258153;
points[4] = 0.0324586288177215;
points[5] = 0;
points[6] = 0.0104252377344665;
points[7] = 0.0140473535914225;
points[8] = 0;
points[9] = 0.0646002912861796;
points[10] = 0.0100590221094308;
pointArray = points;
swSketchSegment = (SketchSegment)swSketchManager.CreateSpline2((pointArray), false);
swSketchManager.InsertSketch(true);
swModel.ClearSelection2(true);
//Insert projected curve
status = swModelDocExt.SelectByID2("Sketch2", "SKETCH", 0, 0, 0, true, 0, null, 0);
status = swModelDocExt.SelectByID2("", "FACE", -0.0497146993259321, 0, -0.0256283866693252, true, 0, null, 0);
swFeature = (Feature)swModel.InsertProjectedSketch2(1);
//Get projected curve data
status = swModelDocExt.SelectByID2("Curve1", "REFCURVE", 0, 0, 0, false, 0, null, 0);
swSelectionManager = (SelectionMgr)swModel.SelectionManager;
swFeature = (Feature)swSelectionManager.GetSelectedObject6(1, -1);
swProjectionCurveFeatureData = (ProjectionCurveFeatureData)swFeature.GetDefinition();
swProjectionCurveFeatureData.AccessSelections(swModel, null);
Debug.Print("Is reversed = " + swProjectionCurveFeatureData.Reverse);
Debug.Print("Number of targeted faces = " + swProjectionCurveFeatureData.GetFaceArrayCount());
swFeature = (Feature)swProjectionCurveFeatureData.Sketch;
swSketch = (Sketch)swFeature.GetSpecificFeature2();
Debug.Print("Name of sketch = " + swFeature.Name);
swProjectionCurveFeatureData.ReleaseSelectionAccess();
}
/// <summary>
/// The SldWorks swApp variable is pre-assigned for you.
/// </summary>
public SldWorks swApp;
}
}