Get Properties of Sketch Pattern Feature Example (C#)

This example shows how to get the properties of a sketch pattern feature.

//----------------------------------------------------------------
// Preconditions:
// 1. Verify that the specified document exists.
// 2. Open an Immediate window.
//
// Postconditions:
// 1. Creates Boss-Extrude2, Sketch3, and Sketch-Pattern1.
// 2. Inspect the Immediate window.
//
// NOTE: Because the model is used elsewhere, do not save changes.
//----------------------------------------------------------------
using Microsoft.VisualBasic;
using System;
using System.Collections;
using System.Collections.Generic;
using System.Data;
using System.Diagnostics;
using SolidWorks.Interop.sldworks;
using SolidWorks.Interop.swconst;
using System.Runtime.InteropServices;
namespace CreateSketchDrivenPattern_CSharp.csproj
{
    partial class SolidWorksMacro
    {
 
        ModelDoc2 Part;
        Feature myFeature;
        SketchPatternFeatureData swSketchPatt;
        double[] vBasePt;
        object skPoint;
        object vSkLines;
        Sketch swSketch;
        Feature swSketchFeat;
        MathTransform swPatternTransform;
        bool boolstatus;
        int i;
        int longstatus;
        int longwarnings;
 
        public void Main()
        {
            Part = (ModelDoc2)swApp.OpenDoc6("C:\\Users\\Public\\Documents\\SOLIDWORKS\\SOLIDWORKS 2017\\tutorial\\api\\block20.sldprt", 1, 0, "", ref longstatus, ref longwarnings);
            swApp.ActivateDoc2("block20", false, ref longstatus);
 
            boolstatus = Part.Extension.SelectByID2("", "FACE", -0.0407921768468213, 0.0396239999998329, -0.0402814031592129, false, 0, null, 0);
            boolstatus = Part.Extension.SetUserPreferenceToggle((int)swUserPreferenceToggle_e.swSketchAddConstToRectEntity, (int)swUserPreferenceOption_e.swDetailingNoOptionSpecified, false);
            boolstatus = Part.Extension.SetUserPreferenceToggle((int)swUserPreferenceToggle_e.swSketchAddConstLineDiagonalType, (int)swUserPreferenceOption_e.swDetailingNoOptionSpecified, true);
            vSkLines = Part.SketchManager.CreateCornerRectangle(-0.0518589252521906, 0.0451811131877662, 0, -0.0357471289475484, 0.0286242963995278, 0);
            Part.SketchManager.InsertSketch(true);
 
            boolstatus = Part.Extension.SelectByID2("Sketch2", "SKETCH", 0, 0, 0, false, 4, null, 0);
            myFeature = Part.FeatureManager.FeatureExtrusion2(true, false, false, 0, 0, 0.00254, 0.00254, false, false, false,
            false, 0.0174532925199433, 0.0174532925199433, false, false, false, false, true, true, true,
            0, 0, false);
 
            Part.SketchManager.InsertSketch(true);
            boolstatus = Part.Extension.SelectByID2("", "FACE", -0.00770328176440671, 0.0396239999998897, -0.00762437790422155, false, 0, null, 0);
            skPoint = Part.SketchManager.CreatePoint(-0.00527, 0.051345, 0.0);
            skPoint = Part.SketchManager.CreatePoint(-0.005854, 0.025783, 0.0);
            skPoint = Part.SketchManager.CreatePoint(-0.005888, -9E-06, 0.0);
            skPoint = Part.SketchManager.CreatePoint(0.019408, 0.051285, 0.0);
            skPoint = Part.SketchManager.CreatePoint(0.019093, 0.024628, 0.0);
            skPoint = Part.SketchManager.CreatePoint(0.019629, -0.000148, 0.0);
            skPoint = Part.SketchManager.CreatePoint(0.043756, 0.051962, 0.0);
            skPoint = Part.SketchManager.CreatePoint(0.043146, 0.025865, 0.0);
            skPoint = Part.SketchManager.CreatePoint(0.043401, 0.000225, 0.0);
            Part.ClearSelection2(true);
            Part.SketchManager.InsertSketch(true);
 
            boolstatus = Part.Extension.SelectByID2("Boss-Extrude2", "BODYFEATURE", -0.0477922378944982, 0.0421639999998433, 0.0233214950450815, false, 4, null, 0);
            boolstatus = Part.Extension.SelectByID2("Sketch3", "SKETCH", 0, 0, 0, true, 64, null, 0);
 
            swSketchFeat = Part.FeatureManager.FeatureSketchDrivenPattern(true, false);
            swSketchPatt = (SketchPatternFeatureData)swSketchFeat.GetDefinition();
 
            swSketchPatt.AccessSelections(Part, null);
 
            swSketch = (Sketch)swSketchPatt.Sketch;
            i = swSketch.GetSketchPointsCount2();
 
            swPatternTransform = swSketchPatt.GetTransform(i);
 
            vBasePt = (double[])swSketchPatt.GetBasePoint();
 
            Debug.Print(swSketchFeat.Name);
            Debug.Print("  Create pattern using only geometry? " + swSketchPatt.GeometryPattern);
            Debug.Print("  Pattern seed coordinates in mm:  (" + vBasePt[0] * 1000.0 + ", " + vBasePt[1] * 1000.0 + ", " + vBasePt[2] * 1000.0 + ")");
            Debug.Print("  Body count: " + swSketchPatt.GetPatternBodyCount());
            Debug.Print("  Face count: " + swSketchPatt.GetPatternFaceCount());
            Debug.Print("  Feature count: " + swSketchPatt.GetPatternFeatureCount());
            Debug.Print("  Reference point type (-1 for centroid): " + swSketchPatt.GetReferencePointType());
            Debug.Print("  Use centroid as the reference point? " + swSketchPatt.UseCentroid);
            Debug.Print("  Propagate visual properties? " + swSketchPatt.PropagateVisualProperty);
 
            swSketchPatt.ReleaseSelectionAccess();
 
        }
 
        /// <summary>
        /// The SldWorks swApp variable is pre-assigned for you.
        /// </summary>
 
        public SldWorks swApp;
 
    }
}