Hide Table of Contents

Get Weldment Cut List Feature and Annotations Example (VBA)

This example shows how to get a weldment cut list feature and weldment cut list annotations.

'----------------------------------------------------------------------------
' Preconditions:
' 1. Open a drawing document that has a weldment cut list table.
' 2. Open an Immediate window.
'
' Postconditions: Inspect the Immediate window.
'----------------------------------------------------------------------------

Option Explicit

Dim swApp As SldWorks.SldWorks
Dim swModel As SldWorks.ModelDoc2
Dim swFeature As SldWorks.Feature
Dim swWeldmentCutListFeat As SldWorks.WeldmentCutListFeature
Dim vWeldCutListAnnotations As Variant
Dim vCustProperties As Variant
Dim i As Long
Dim j As Long

Sub main()

    Set swApp = Application.SldWorks
    Set swModel = swApp.ActiveDoc
   

    ' Traverse FeatureManager design tree
    ' Get first feature in FeatureManager design tree
    Set swFeature = swModel.FirstFeature
    

    ' If the type of feature is "WeldmentTableFeat"
    ' then get the WeldmentCutListFeature object
    Do While Not swFeature Is Nothing
   

        If swFeature.GetTypeName = "WeldmentTableFeat" Then

            Debug.Print swFeature.Name
            Set swWeldmentCutListFeat = swFeature.GetSpecificFeature2
            Debug.Print "   Name of configuration:    " & swWeldmentCutListFeat.Configuration
            Debug.Print "   Keep missing items:       " & swWeldmentCutListFeat.KeepCurrentItemNumbers
            Debug.Print "   Strike out missing items:  " & swWeldmentCutListFeat.StrikeoutMissingItems
            Debug.Print "   Starting sequence number: " & swWeldmentCutListFeat.SequenceStartNumber

            ' Get the weldment cut list annotations
            vWeldCutListAnnotations = swWeldmentCutListFeat.GetTableAnnotations
            For i = LBound(vWeldCutListAnnotations) To UBound(vWeldCutListAnnotations)
                ' Print the number custom properties and then the custom properties
                Debug.Print "   Number of custom properties: " & vWeldCutListAnnotations(i).GetAllCustomPropertiesCount
                vCustProperties = vWeldCutListAnnotations(i).GetAllCustomProperties
                For j = LBound(vCustProperties) To UBound(vCustProperties)
                    Debug.Print "        Custom property: " & vCustProperties(j)
                Next j
            Next i
        End If
   

        ' Get the next feature in the FeatureManager design tree
        Set swFeature = swFeature.GetNextFeature
   

    Loop

End Sub



Provide feedback on this topic

SOLIDWORKS welcomes your feedback concerning the presentation, accuracy, and thoroughness of the documentation. Use the form below to send your comments and suggestions about this topic directly to our documentation team. The documentation team cannot answer technical support questions. Click here for information about technical support.

* Required

 
*Email:  
Subject:   Feedback on Help Topics
Page:   Get Weldment Cut List Feature and Annotations Example (VBA)
*Comment:  
*   I acknowledge I have read and I hereby accept the privacy policy under which my Personal Data will be used by Dassault Systèmes

Print Topic

Select the scope of content to print:



x

We have detected you are using a browser version older than Internet Explorer 7. For optimized display, we suggest upgrading your browser to Internet Explorer 7 or newer.

 Never show this message again
x

Web Help Content Version: API Help (English only) 2017 SP05

To disable Web help from within SOLIDWORKS and use local help instead, click Help > Use SOLIDWORKS Web Help.

To report problems encountered with the Web help interface and search, contact your local support representative. To provide feedback on individual help topics, use the “Feedback on this topic” link on the individual topic page.