Hide Table of Contents

Get and Set Hole Callout Variables Example (VB.NET)

This example shows how to get and set hole callout variables.

'--------------------------------------------------------
' Preconditions:
' 1. Open a drawing document containing a hole callout.
' 2. Select the hole callout.
' 3. Open the Immediate window.
'
' Postconditions:
' 1. Iterates through the variables in the hole callout and
'    gets any angle, length, and string callout
'    variables.
' 2. If the hole callout variable is a length variable,
'    then sets its precision and tolerance type.
' 3. Examine the Immediate window.
'--------------------------------------------------------
Imports SolidWorks.Interop.sldworks
Imports SolidWorks.Interop.swconst
Imports System.Runtime.InteropServices
Imports System
Imports System.Diagnostics
 
Partial Class SolidWorksMacro
 
    Public Sub main()
        Dim swModel As ModelDoc2
        Dim swSelMgr As SelectionMgr
        Dim swDisplayDimension As DisplayDimension
        Dim swCalloutLengthVariable As CalloutLengthVariable
        Dim swCalloutAngleVariable As CalloutAngleVariable
        Dim swCalloutStringVariable As CalloutStringVariable
        Dim swCalloutVariable As CalloutVariable
        Dim i As Integer
        Dim vType As Integer
        Dim holeVariables As Object
        Dim str1 As String
        Dim str2 As String
 
        swModel = swApp.ActiveDoc
        swSelMgr = swModel.SelectionManager
 
        'Get the selected hole callout
        swDisplayDimension = swSelMgr.GetSelectedObject6(1, -1)
        holeVariables = swDisplayDimension.GetHoleCalloutVariables
        Debug.Print("Number of hole callout variables = " & UBound(holeVariables) + 1)
        Debug.Print("")
 
        'Determine type of hole callout variable and get and set some values
        For i = 0 To UBound(holeVariables)
            swCalloutVariable = holeVariables(i)
            str1 = "  Callout variable name = " & swCalloutVariable.VariableName
            str2 = "  Callout variable name as it appears in Dimension PropertyManager page = " & swCalloutVariable.UserReadableVariableName
            vType = swCalloutVariable.Type
            If vType = swCalloutVariableType_e.swCalloutVariableType_Length Then
                swCalloutLengthVariable = swCalloutVariable
                Debug.Print("Callout variable(" & i & ")'s" & " type = length")
                Debug.Print(str1)
                Debug.Print(str2)
                Debug.Print("  Length = " & swCalloutLengthVariable.Length)
                Debug.Print("  Precision = " & swCalloutLengthVariable.Precision)
                Debug.Print("  Tolerance precision = " & swCalloutLengthVariable.TolerancePrecision)
                swCalloutLengthVariable.Precision = swCalloutLengthVariable.Precision - 1 - i
                Debug.Print("  Changed precision = " & swCalloutLengthVariable.Precision)
                swCalloutVariable.ToleranceType = swTolType_e.swTolBILAT
            ElseIf vType = swCalloutVariableType_e.swCalloutVariableType_Angle Then
                swCalloutAngleVariable = swCalloutVariable
                Debug.Print("Callout variable(" & i & ")'s" & " type = angle")
                Debug.Print(str1)
                Debug.Print(str2)
                Debug.Print("  Angle = " & swCalloutAngleVariable.Angle)
            ElseIf vType = swCalloutVariableType_e.swCalloutVariableType_String Then
                swCalloutStringVariable = swCalloutVariable
                Debug.Print("Callout variable(" & i & ")'s" & " type = string")
                Debug.Print(str1)
                Debug.Print(str2)
                Debug.Print("  String = '" & swCalloutStringVariable.String & "'")
            End If
        Next
 
    End Sub
 
    ''' <summary>
    ''' The SldWorks swApp variable is pre-assigned for you.
    ''' </summary>
    Public swApp As SldWorks
 
 
End Class

 



Provide feedback on this topic

SOLIDWORKS welcomes your feedback concerning the presentation, accuracy, and thoroughness of the documentation. Use the form below to send your comments and suggestions about this topic directly to our documentation team. The documentation team cannot answer technical support questions. Click here for information about technical support.

* Required

 
*Email:  
Subject:   Feedback on Help Topics
Page:   Get and Set Hole Callout Variables Example (VB.NET)
*Comment:  
*   I acknowledge I have read and I hereby accept the privacy policy under which my Personal Data will be used by Dassault Systèmes

Print Topic

Select the scope of content to print:



x

We have detected you are using a browser version older than Internet Explorer 7. For optimized display, we suggest upgrading your browser to Internet Explorer 7 or newer.

 Never show this message again
x

Web Help Content Version: API Help (English only) 2017 SP05

To disable Web help from within SOLIDWORKS and use local help instead, click Help > Use SOLIDWORKS Web Help.

To report problems encountered with the Web help interface and search, contact your local support representative. To provide feedback on individual help topics, use the “Feedback on this topic” link on the individual topic page.