Hide Table of Contents

Insert Sheet Metal Gusset Feature Example (C#)

This example shows how to insert a sheet metal gusset feature and modify its data.

//----------------------------------------------------------------------------
// Preconditions:
// 1. Open public_documents\tutorial\api\SMGussetAPI.sldprt.
// 2. Open an Immediate window.
//
// Postconditions:
// 1. Inserts four sheet metal gussets.
// 2. Press F5 repeatedly and observe the gusset modifications.
// 3. Inspect the Immediate window for the flatten settings of all gussets.
// 4. Expand Flat-Pattern in the FeatureManager design tree, right-click 
//    Flat-Pattern(1), and click Unsuppress.
// 5. Observe the center marks and profiles of all the gussets in their
//    flattened states.
//
// NOTE: Because the model is used elsewhere, do not save changes.
// ---------------------------------------------------------------------------
using Microsoft.VisualBasic;
using System;
using System.Collections;
using System.Collections.Generic;
using System.Data;
using System.Diagnostics;
using SolidWorks.Interop.sldworks;
using SolidWorks.Interop.swconst;
using System.Runtime.InteropServices;
namespace InsertSMGusset_CSharp.csproj
{
    partial class SolidWorksMacro
    {
 
        ModelDoc2 Part;
        Feature myFeature;
        Feature myFeature1;
        Feature myFeature2;
        Feature myFeature3;
        Feature swFeat;
        SMGussetFeatureData swFeatData;
 
        bool boolstatus;
 
        public void Main()
        {
            Part = (ModelDoc2)swApp.ActiveDoc;
 
            boolstatus = Part.Extension.SelectByID2("""FACE", -0.0538403893476698, 0.0036701308754914, 0.05530817474488, false, 0, null, 0);
            boolstatus = Part.Extension.SelectByID2("""FACE", -0.0177780871801474, -0.0307393226379986, 0.0341128529187245, true, 0, null, 0);
 
            // Gusset #1 insertion parameters
            //1.  bOffset                    = True
            //2.  dOffset                    = 50 mm
            //3.  bFlipOffsetSide            = False
            //4.  profDimType                = 0 (indent depth dimensioning scheme)
            //5.  dIndentDepth               = 10 mm
            //6.  dLength                    = 0
            //7.  bUseAngle                  = False
            //8.  dHeight                    = 0
            //9   dAngle                     = 0
            //10. bFlipSides                 = False
            //11. dWidth                     = 10 mm
            //12. dThickness                 = 3 mm
            //13. bDraft                     = True
            //14. dDraftAngle                = 3 degrees
            //15. bInnerCornerFillet         = True
            //16. dInnerCornerFilletRadius   = 2 mm
            //17. bOuterCornerFillet         = True
            //18. dOuterCornerFilletRadius   = 1 mm
            //19. gussetType                 = 0 (rounded back)
            //20  bEdgeFillet                = False
            //21. dEdgeFilletRadius          = 0 mm
            //22. bOverrideDoc               = True
            //23. bShowProfile               = True
            //24. bShowCenter                = True
 
            myFeature = Part.FeatureManager.InsertSheetMetalGussetFeature3(true, 0.05, false, (int)swSheetMetalGussetProfileDimType_e.swSheetMetalGussetProfileDimType_IndentDepth, 0.01, 0, false, 0, 0, true,
            0.01, 0.003, true, 3 * 0.0175, true, 0.002, true, 0.001, (int)swSheetMetalRibGussetType_e.swSheetMetalRibGussetType_Rounded, false,
            0, truetruetrue);
            Part.ClearSelection2(true);
 
            // Gusset #2 insertion parameters (same as for Gusset #1 with the following exceptions)
            //2.  dOffset                = 30 mm
            //19. gussetType             = 1 (flat back)
            //20  bEdgeFillet            = True
            //21. dEdgeFilletRadius      = 1 mm
 
            //Select faces
            boolstatus = Part.Extension.SelectByID2("""FACE", -0.0538403893476698, 0.0036701308754914, 0.05530817474488, false, 0, null, 0);
            boolstatus = Part.Extension.SelectByID2("""FACE", -0.0177780871801474, -0.0307393226379986, 0.0341128529187245, true, 0, null, 0);
 
            myFeature1 = Part.FeatureManager.InsertSheetMetalGussetFeature3(true, 0.03, false, (int)swSheetMetalGussetProfileDimType_e.swSheetMetalGussetProfileDimType_IndentDepth, 0.01, 0, false, 0, 0, false,
            0.01, 0.003, true, 3 * 0.0175, true, 0.002, true, 0.001, (int)swSheetMetalRibGussetType_e.swSheetMetalRibGussetType_Flat, true,
            0.001, truetruetrue);
            Part.ClearSelection2(true);
 
            // Gusset #3 insertion parameters (same as for Gusset #1 with the following exceptions)
            //2.  dOffset                = 30 mm
            //4.  profDimType            = 1 (length + height dimensioning scheme)
            //5.  dIndentDepth           = 0 mm
            //6.  dLength                = 25 mm
            //7.  bUseAngle              = False
            //8.  dHeight                = 15 mm
            //9   dAngle                 = 0
            //10. bFlipSides             = False
            //19. gussetType             = 1 (flat back)
            //20  bEdgeFillet            = True
            //21. dEdgeFilletRadius      = 1 mm
 
            boolstatus = Part.Extension.SelectByID2("""FACE", -0.0538403893476698, 0.0036701308754914, 0.05530817474488, false, 0, null, 0);
            boolstatus = Part.Extension.SelectByID2("""FACE", -0.0177780871801474, -0.0307393226379986, 0.0341128529187245, true, 0, null, 0);
 
            myFeature2 = Part.FeatureManager.InsertSheetMetalGussetFeature3(true, 0.03, false, (int)swSheetMetalGussetProfileDimType_e.swSheetMetalGussetProfileDimType_ProfileDimensions, 0, 0.025, false, 0.015, 0, false,
            0.02, 0.003, true, 3 * 0.0175, true, 0.002, true, 0.001, (int)swSheetMetalRibGussetType_e.swSheetMetalRibGussetType_Flat, true,
            0.001, truetruetrue);
            Part.ClearSelection2(true);
 
            // Gusset #4 insertion parameters (same as for Gusset #1 with the following exceptions)
            //2.  dOffset                = 30 mm
            //20  bEdgeFillet            = True
            //21. dEdgeFilletRadius      = 1 mm
 
            //Select orientation and position references
            boolstatus = Part.Extension.SelectByID2("""FACE", -0.0538403893476129, -0.00224553153327633, 0.087801420904043, true, 0, null, 0);
            boolstatus = Part.Extension.SelectByID2("""FACE", -0.0235965800548001, -0.0307393226379986, 0.0897844682415894, true, 0, null, 0);
            boolstatus = Part.Extension.SelectByID2("Line1@Sketch6""EXTSKETCHSEGMENT", -0.00609049483400968, -0.0895139047397037, 0, true, 0, null, 0);
            boolstatus = Part.Extension.SelectByID2("Point1@Sketch7""EXTSKETCHPOINT", 0.0180407947995604, -0.0762728416981986, 0, true, 0, null, 0);
 
            myFeature3 = Part.FeatureManager.InsertSheetMetalGussetFeature3(true, 0.03, false, (int)swSheetMetalGussetProfileDimType_e.swSheetMetalGussetProfileDimType_IndentDepth, 0.01, 0, false, 0, 0, false,
            0.01, 0.003, true, 3 * 0.0175, true, 0.002, true, 0.001, (int)swSheetMetalRibGussetType_e.swSheetMetalRibGussetType_Rounded, true,
            0.001, truetruetrue);
            Part.ClearSelection2(true);
 
            System.Diagnostics.Debugger.Break();
 
            //Five modifications to gusset feature data:
 
            //a. Modify type, draft, and outer corner fillet options for gusset #1
            boolstatus = Part.Extension.SelectByID2("Sheet Metal Gusset1""BODYFEATURE", 0, 0, 0, false, 0, null, 0);
            swFeat = (Feature)((SelectionMgr)(Part.SelectionManager)).GetSelectedObject6(1, -1);
 
            swFeatData = (SMGussetFeatureData)swFeat.GetDefinition();
            swFeatData.AccessSelections(Part, null);
 
            swFeatData.GussetType = 1; //flat back
            swFeatData.DraftSideFaces = false;
            swFeatData.FilletOuterCorners = false; //no outer corner fillet
           
            Debug.Print("Sheet Metal Gusset1 Flatten Settings");
            Debug.Print("  Override document property settings? " + swFeatData.OverrideDocSettings);
            Debug.Print("  Show center marks? " + swFeatData.ShowCenter);
            Debug.Print("  Show profile? " + swFeatData.ShowProfile);
 
            swFeat.ModifyDefinition(swFeatData, Part, null);
            swFeatData.ReleaseSelectionAccess();
 
            System.Diagnostics.Debugger.Break();
 
            //b. Modify orientation reference of gusset #3
            boolstatus = Part.Extension.SelectByID2("Sheet Metal Gusset3""BODYFEATURE", 0, 0, 0, false, 0, null, 0);
            swFeat = (Feature)((SelectionMgr)(Part.SelectionManager)).GetSelectedObject6(1, -1);
 
            swFeatData = (SMGussetFeatureData)swFeat.GetDefinition();
            swFeatData.AccessSelections(Part, null);
 
            boolstatus = Part.Extension.SelectByID2("Line1@Sketch6""EXTSKETCHSEGMENT", -0.00609049483400968, -0.0895139047397037, 0, true, 0, null, 0);
 
            object refLine = null;
            refLine = ((SelectionMgr)(Part.SelectionManager)).GetSelectedObject6(1, -1);
            swFeatData.ReferenceLine = refLine;
 
            swFeat.ModifyDefinition(swFeatData, Part, null);
 
            System.Diagnostics.Debugger.Break();
 
            //c. Modify legs of gusset #2: select one bend face instead of two flat faces
            boolstatus = Part.Extension.SelectByID2("Sheet Metal Gusset2""BODYFEATURE", 0, 0, 0, false, 0, null, 0);
            swFeat = (Feature)((SelectionMgr)(Part.SelectionManager)).GetSelectedObject6(1, -1);
 
            swFeatData = (SMGussetFeatureData)swFeat.GetDefinition();
            swFeatData.AccessSelections(Part, null);
 
            boolstatus = Part.Extension.SelectByID2("""FACE", 0.03831148650454, -0.0327672470662037, 0.147978181958194, false, 0, null, 0);
 
            object newBendFace = null;
            Face2[] bendfaces = new Face2[1];
            bendfaces[0] = (Face2)((SelectionMgr)(Part.SelectionManager)).GetSelectedObject6(1, -1);
 
            newBendFace = bendfaces;
            swFeatData.SupportingFaces = newBendFace;
            Debug.Print("Sheet Metal Gusset2 Flatten Settings");
            Debug.Print("  Override document property settings? " + swFeatData.OverrideDocSettings);
            Debug.Print("  Show center marks? " + swFeatData.ShowCenter);
            Debug.Print("  Show profile? " + swFeatData.ShowProfile);
 
            swFeat.ModifyDefinition(swFeatData, Part, null);
 
            System.Diagnostics.Debugger.Break();
 
            //d. Modify reference position of gusset #3 - 3 mm away from vertex of hexagonal cut
            boolstatus = Part.Extension.SelectByID2("Sheet Metal Gusset3""BODYFEATURE", 0, 0, 0, false, 0, null, 0);
            swFeat = (Feature)((SelectionMgr)(Part.SelectionManager)).GetSelectedObject6(1, -1);
 
            swFeatData = (SMGussetFeatureData)swFeat.GetDefinition();
            swFeatData.AccessSelections(Part, null);
 
            boolstatus = Part.Extension.SelectByID2("""VERTEX", -0.0538403893475499, -0.0100654290631334, 0.205954465964501, false, 0, null, 0);
 
            object refPoint = null;
            refPoint = ((SelectionMgr)(Part.SelectionManager)).GetSelectedObject6(1, -1);
            swFeatData.ReferencePoint = refPoint;
            Debug.Print("Sheet Metal Gusset3 Flatten Settings");
            Debug.Print("  Override document property settings? " + swFeatData.OverrideDocSettings);
            Debug.Print("  Show center marks? " + swFeatData.ShowCenter);
            Debug.Print("  Show profile? " + swFeatData.ShowProfile);
 
            swFeat.ModifyDefinition(swFeatData, Part, null);
 
            System.Diagnostics.Debugger.Break();
 
            //e. Modify type and inner corner fillet options for gusset #4
            boolstatus = Part.Extension.SelectByID2("Sheet Metal Gusset4""BODYFEATURE", 0, 0, 0, false, 0, null, 0);
            swFeat = (Feature)((SelectionMgr)(Part.SelectionManager)).GetSelectedObject6(1, -1);
 
            swFeatData = (SMGussetFeatureData)swFeat.GetDefinition();
            swFeatData.AccessSelections(Part, null);
 
            swFeatData.GussetType = 0; //rounded back
            swFeatData.FilletInnerCorners = false; //no inner corner fillet
            
            Debug.Print("Sheet Metal Gusset4 Flatten Settings");
            Debug.Print("  Override document property settings? " + swFeatData.OverrideDocSettings);
            Debug.Print("  Show center marks? " + swFeatData.ShowCenter);
            Debug.Print("  Show profile? " + swFeatData.ShowProfile);
 
            swFeat.ModifyDefinition(swFeatData, Part, null);
            swFeatData.ReleaseSelectionAccess();
 
 
        }
 
        /// <summary>
        /// The SldWorks swApp variable is pre-assigned for you.
        /// </summary>
 
        public SldWorks swApp;
 
    }
}

 



Provide feedback on this topic

SOLIDWORKS welcomes your feedback concerning the presentation, accuracy, and thoroughness of the documentation. Use the form below to send your comments and suggestions about this topic directly to our documentation team. The documentation team cannot answer technical support questions. Click here for information about technical support.

* Required

 
*Email:  
Subject:   Feedback on Help Topics
Page:   Insert Sheet Metal Gusset Feature Example (C#)
*Comment:  
*   I acknowledge I have read and I hereby accept the privacy policy under which my Personal Data will be used by Dassault Systèmes

Print Topic

Select the scope of content to print:



x

We have detected you are using a browser version older than Internet Explorer 7. For optimized display, we suggest upgrading your browser to Internet Explorer 7 or newer.

 Never show this message again
x

Web Help Content Version: API Help (English only) 2017 SP05

To disable Web help from within SOLIDWORKS and use local help instead, click Help > Use SOLIDWORKS Web Help.

To report problems encountered with the Web help interface and search, contact your local support representative. To provide feedback on individual help topics, use the “Feedback on this topic” link on the individual topic page.