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Insert Sketch Text and Hole Example (VBA)

This example shows how to insert sketch text and a hole at the selected point on a face.

'----------------------------------------------------------------------------
' Preconditions: Open a model document and select a face.
'
' Postconditions:
' 1. Creates a hole and inserts the specified text on the
'    face at its point of selection.
' 2. Examine the graphics area and FeatureManager design tree.
'----------------------------------------------------------------------------

Option Explicit

Dim swApp As SldWorks.SldWorks
Dim swModel As SldWorks.ModelDoc2
Dim swSelMgr As SldWorks.SelectionMgr
Dim swMathPt As SldWorks.MathPoint
Dim selFace As Face2
Dim selEnt As Entity
Dim selPt As Variant
Dim NewPt As Variant
Dim swMathUtil As SldWorks.MathUtility
Dim swMathTrans As SldWorks.MathTransform
Dim selData As SldWorks.SelectData
Dim swSketchMgr As SldWorks.SketchManager
Dim skText As SketchText
Dim ptArr(2) As Double
Dim params As Variant
Dim holeFeat As SldWorks.Feature
Dim swFeatMgr As SldWorks.FeatureManager
Dim boolstatus As Boolean

Function TransformPoint(ByVal Sketch1 As SldWorks.Sketch, ByVal X As Double, ByVal Y As Double, ByVal Z As Double) As Variant

    ptArr(0) = X
    ptArr(1) = Y
    ptArr(2) = Z
 

    Set swMathUtil = swApp.GetMathUtility
    Set swMathPt = swMathUtil.CreatePoint((ptArr))

    params = swMathPt.ArrayData

    Set swMathTrans = Sketch1.ModelToSketchTransform
    Set swMathPt = swMathPt.MultiplyTransform(swMathTrans)

    NewPt = swMathPt.ArrayData

    TransformPoint = NewPt

End Function

Sub main()

    Set swApp = Application.SldWorks
    Set swModel = swApp.ActiveDoc
    Set swSelMgr = swModel.SelectionManager
    Set selFace = swSelMgr.GetSelectedObject6(1, -1)
    Set selEnt = selFace
   

    selPt = swSelMgr.GetSelectionPoint2(1, -1)
    

    Set selData = swSelMgr.CreateSelectData
   

    selData.X = selPt(0)
    selData.Y = selPt(1)
    selData.Z = selPt(2)
   

    Set swSketchMgr = swModel.SketchManager
   

    swSketchMgr.InsertSketch True
   

    selPt = TransformPoint(swModel.IGetActiveSketch2, selPt(0), selPt(1), selPt(2))
   

    Set skText = swModel.InsertSketchText(selPt(0), selPt(1), selPt(2), "Hole", 0, 0, 0, 100, 100)
   

    params = skText.GetCoordinates
 

    swSketchMgr.InsertSketch True
   

    boolstatus = selEnt.Select4(False, selData)
   

    Set swFeatMgr = swModel.FeatureManager
    Set holeFeat = swFeatMgr.SimpleHole2(0.001, True, False, False, 0, 0, 0.001, 0.001, False, False, False, False, 0, 0, False, False, False, False, True, True, False, False, False)
   

End Sub



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