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Insert Sketch Text and Hole Example (VB.NET)

This example shows how to insert sketch text and a hole at the selected point on a face.

'----------------------------------------------------------------------------
' Preconditions: Open a model document and select a face.
'
' Postconditions: 
' 1. Creates a hole and inserts the specified text on the

'    face at its point of selection.
' 2. Examine the graphics area and FeatureManager design tree.

'----------------------------------------------------------------------------
Imports SolidWorks.Interop.sldworks
Imports SolidWorks.Interop.swconst
Imports System.Runtime.InteropServices
Imports System
 
Partial Class SolidWorksMacro
 
    Dim swModel As ModelDoc2
    Dim swSelMgr As SelectionMgr
    Dim swMathPt As MathPoint
    Dim selFace As Face2
    Dim selEnt As Entity
    Dim selPt As Object
    Dim NewPt As Object
    Dim swMathUtil As MathUtility
    Dim swMathTrans As MathTransform
    Dim selData As SelectData
    Dim swSketchMgr As SketchManager
    Dim skText As SketchText
    Dim ptArr(2) As Double
    Dim params As Object
    Dim holeFeat As Feature
    Dim swFeatMgr As FeatureManager
    Dim boolstatus As Boolean
 
 
    Function TransformPoint(ByVal Sketch1 As Sketch, ByVal X As DoubleByVal Y As DoubleByVal Z As DoubleAs Object
 
        ptArr(0) = X
        ptArr(1) = Y
        ptArr(2) = Z
 
        swMathUtil = swApp.GetMathUtility
        swMathPt = swMathUtil.CreatePoint((ptArr))
 
        params = swMathPt.ArrayData
 
        swMathTrans = Sketch1.ModelToSketchTransform
        swMathPt = swMathPt.MultiplyTransform(swMathTrans)
 
        NewPt = swMathPt.ArrayData
 
        TransformPoint = NewPt
 
    End Function
 
 
    Sub main()
 
        swModel = swApp.ActiveDoc
        swSelMgr = swModel.SelectionManager
        selFace = swSelMgr.GetSelectedObject6(1, -1)
        selEnt = selFace
 
        selPt = swSelMgr.GetSelectionPoint2(1, -1)
 
        selData = swSelMgr.CreateSelectData
 
        selData.X = selPt(0)
        selData.Y = selPt(1)
        selData.Z = selPt(2)
 
        swSketchMgr = swModel.SketchManager
 
        swSketchMgr.InsertSketch(True)
 
        selPt = TransformPoint(swModel.IGetActiveSketch2, selPt(0), selPt(1), selPt(2))
 
        skText = swModel.InsertSketchText(selPt(0), selPt(1), selPt(2), "Hole", 0, 0, 0, 100, 100)
 
        params = skText.GetCoordinates
 
        swSketchMgr.InsertSketch(True)
 
        boolstatus = selEnt.Select4(False, selData)
 
        swFeatMgr = swModel.FeatureManager
        holeFeat = swFeatMgr.SimpleHole2(0.001, TrueFalseFalse, 0, 0, 0.001, 0.001, FalseFalseFalseFalse, 0, 0, FalseFalseFalseFalseTrueTrueFalseFalseFalse)
 
 
    End Sub
 
 
    ''' <summary>
    ''' The SldWorks swApp variable is pre-assigned for you.
    ''' </summary>
    Public swApp As SldWorks
 
 
End Class
 

 



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