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Insert Sweep Cut Feature Example (C#)

This example shows how to create a sweep cut feature and get its properties.

//----------------------------------------------------------------
// Preconditions:
// 1. Verify that the part to open exists.
// 2. Open an Immediate window.
//
// Postconditions:
// 1. Creates Cut-Sweep1.
// 2. Inspect the FeatureManager design tree, graphics area,
//    and Immediate window.
//
// NOTE: Because this part document is used elsewhere,
// do not save changes.
//---------------------------------------------------------------
using SolidWorks.Interop.sldworks;
using SolidWorks.Interop.swconst;
using System;
using System.Diagnostics;
namespace InsertSweepCut_CSharp.csproj
{
    
partial class SolidWorksMacro
    {

        
ModelDoc2 Part;
        
bool boolstatus;
        
int longstatus;
        
int longwarnings;
        
SweepFeatureData swSweep;
        
Feature swProfFeat;
        
Sketch swProfSketch;
        
Feature swPathFeat;
        
Sketch swPathSketch;
        
bool bRet;

        
public enum swTangencyType_e
        {
            swTangencyNone = 0,
            swTangencyNormalToProfile = 1,
            swTangencyDirectionVector = 2,
            swTangencyAllFaces = 3
        }

        
public enum swThinWallType_e
        {
            swThinWallOneDirection = 0,
            swThinWallOppDirection = 1,
            swThinWallMidPlane = 2,
            swThinWallTwoDirection = 3
        }

        
public enum swTwistControlType_e
        {
            swTwistControlFollowPath = 0,
            swTwistControlKeepNormalConstant = 1,
            swTwistControlFollowPathFirstGuideCurve = 2,
            swTwistControlFollowFirstSecondGuideCurves = 3
        }

        
public enum swCutSweepOption_e
        {
            swProfileSweep = 1,
            swSolidSweep = 2
        }


        
public void Main()
        {

            Part = swApp.OpenDoc6(
"C:\\Users\\Public\\Documents\\SOLIDWORKS\\SOLIDWORKS 2017\\tutorial\\api\\sweepcutextrude.SLDPRT", 1, 0, "", ref longstatus, ref longwarnings);
            swApp.ActivateDoc2(
"sweepcutextrude.SLDPRT", false, ref longstatus);
            Part = (
ModelDoc2)swApp.ActiveDoc;
            
ModelView myModelView = null;
            myModelView = (
ModelView)Part.ActiveView;
            myModelView.FrameLeft = 0;
            myModelView.FrameTop = 0;

            myModelView.FrameState = (
int)swWindowState_e.swWindowMaximized;
            Part.ShowNamedView2(
"*Isometric", 7);

            boolstatus = Part.Extension.SelectByID2(
"Sketch2", "SKETCH", 0.01948983274156, -0.02564816935317, 0, false, 1, null, 0);
            
// profile has Mark = 1
            boolstatus = Part.Extension.SelectByID2("Sketch3", "SKETCH", -0.03797488317814, -0.02133214444164, 0, true, 4, null, 0);
            
// path sweep has Mark = 4
            Feature myFeature = default(Feature);
            myFeature = Part.FeatureManager.InsertCutSwept4(
false, true, 0, false, false, 0, 0, false, 0, 0,
            0, 0,
true, true, 0, true, true, true, false);

            swSweep = (
SweepFeatureData)myFeature.GetDefinition();
            swProfFeat = (
Feature)swSweep.Profile;
            
Debug.Assert((null != swProfFeat));
            swProfSketch = (
Sketch)swProfFeat.GetSpecificFeature();
            
Debug.Assert((null != swProfSketch));

            
// Rollback to access selections
            bRet = swSweep.AccessSelections(Part, null);
            
Debug.Assert(bRet);

            swPathFeat = (
Feature)swSweep.Path;
            
Debug.Assert((null != swPathFeat));
            swPathSketch = (
Sketch)swPathFeat.GetSpecificFeature();
            
Debug.Assert((null != swPathSketch));

            
Debug.Print("File = " + Part.GetPathName());
            
Debug.Print(" " + myFeature.Name);
            
Debug.Print(" Path = " + swPathFeat.Name);

            
//swTangencyType_e
            Debug.Print(" Path alignment type = " + swSweep.PathAlignmentType);

            
Debug.Print(" Profile = " + swProfFeat.Name);
            
Debug.Print(" AdvancedSmoothing = " + swSweep.AdvancedSmoothing);
            
Debug.Print(" AlignWithEndFaces = " + swSweep.AlignWithEndFaces);
            
Debug.Print(" AutoSelect = " + swSweep.AutoSelect);
            
Debug.Print(" AutoSelectComponents = " + swSweep.AutoSelectComponents);

            
//swTangencyType_e
            Debug.Print(" EndTangencyType = " + swSweep.EndTangencyType);

            
Debug.Print(" AssemblyFeatureScope = " + swSweep.AssemblyFeatureScope);
            
Debug.Print(" FeatureScope = " + swSweep.FeatureScope);
            
Debug.Print(" FeatureScopeBodiesCnt = " + swSweep.GetFeatureScopeBodiesCount());

            
//swSelectType_e
            Debug.Print(" GetPathType = " + swSweep.GetPathType());

            
Debug.Print(" Wall thickness foward = " + swSweep.GetWallThickness(true) * 1000.0 + " mm");
            
Debug.Print(" Wall thickness reverse = " + swSweep.GetWallThickness(false) * 1000.0 + " mm");
            
Debug.Print(" IsBossFeature = " + swSweep.IsBossFeature());
            
Debug.Print(" IsThinFeature = " + swSweep.IsThinFeature());
            
Debug.Print(" MaintainTangency = " + swSweep.MaintainTangency);
            
Debug.Print(" Merge = " + swSweep.Merge);
            
Debug.Print(" MergeSmoothFaces = " + swSweep.MergeSmoothFaces);
            
Debug.Print(" PropagateFeatureToParts = " + swSweep.PropagateFeatureToParts);

            
//swTangencyType_e
            Debug.Print(" StartTangencyType = " + swSweep.StartTangencyType);

            
Debug.Print(" TangentPropagation = " + swSweep.TangentPropagation);
            
Debug.Print(" ThinWallType = " + swSweep.ThinWallType);

            
//swTwistControlType_e
            Debug.Print(" TwistControlType = " + swSweep.TwistControlType);

            
//swCutSweepOption_e
            Debug.Print(" CutSweepOption = " + swSweep.GetCutSweepOption());

            
// Roll forward

            swSweep.ReleaseSelectionAccess();
        }

        
public SldWorks swApp;

    }
}

 



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