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Insert and Resize Sketch Slot Example (VB.NET)

This example shows how to insert a sketch slot and resize it.

' Preconditions:
' 1. Open a new part document.
' 2. Open the Immediate window..
' Postconditions:
' 1. Creates a sketch and inserts a sketch slot.
' 2. Press F5 after examining the graphics area.
' 3. Resizes the slot.
' 4. Examine the graphics area and Immediate window.
Imports SolidWorks.Interop.sldworks
Imports SolidWorks.Interop.swconst
Imports System
Imports System.Diagnostics

Partial Class SolidWorksMacro

    Dim swModel As ModelDoc2
    Dim swExt As ModelDocExtension
    Dim swSelMgr As SelectionMgr
    Dim boolstatus As Boolean
    Dim swPart As PartDoc
    Dim skManager As SketchManager

    Public Sub main()

        swModel = swApp.ActiveDoc
        swExt = swModel.Extension
        swSelMgr = swModel.SelectionManager
        skManager = swModel.SketchManager
        swPart = swModel

        boolstatus = swExt.SelectByID2("Front Plane", "PLANE", 0, 0, 0, False, 0, Nothing, 0)


        Dim swSketchSlot As SketchSlot
        swSketchSlot = skManager.CreateSketchSlot(swSketchSlotCreationType_e.swSketchSlotCreationType_line, swSketchSlotLengthType_e.swSketchSlotLengthType_CenterCenter, 0.05, -0.05, 0, 0, 0.05, 0, 0, 0, 0, 0, 1, False)

        Dim lengthType As swSketchSlotLengthType_e
        lengthType = swSketchSlot.LengthType

        Debug.Print("Length: " & swSketchSlot.Length)
        Debug.Print("Length Type: " & lengthType.ToString())
        Debug.Print("Width: " & swSketchSlot.Width)


        ' Edit the original slot
        swSketchSlot.Width = swSketchSlot.Width * 2.0#
        Debug.Print "Modified width: " & swSketchSlot.Width  

    End Sub

    ''' <summary>
    ''' The SldWorks swApp variable is pre-assigned for you.
    ''' </summary>
    Public swApp As SldWorks
End Class

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