Move Assembly Components to New Folder Example (VBA)

This example shows how to move selected assembly components to a newly created folder in the FeatureManager design tree.

'---------------------------------------------------------------------------
' Preconditions:
' 1. Verify that the specified assembly to open exists.
' 2. Open an Immediate window.
'
' Postconditions:
' 1. Opens the specified assembly document.
' 2. Selects the valve<1> and valve_guide<1> components.
' 3. Creates a folder named Folder1 in the FeatureManager design tree.
' 4. Moves the valve<1> and valve_guide<1> components to Folder1,
'    which you can verify by expanding Folder1.
' 5. Examine the Immediate window.
'
' NOTE: Because the assembly document is used by elsewhere,
' do not save any changes.
'---------------------------------------------------------------------------

Option Explicit

Dim swApp As SldWorks.SldWorks
Dim modelDoc2 As SldWorks.modelDoc2
Dim assemblyDoc As SldWorks.assemblyDoc
Dim featureMgr As SldWorks.FeatureManager
Dim modelDocExt As SldWorks.ModelDocExtension
Dim selectionMgr As SldWorks.selectionMgr
Dim feature As SldWorks.feature
Dim selObj As Object
Dim feat As SldWorks.feature
Dim folderFeat As SldWorks.feature
Dim errors As Long
Dim warnings As Long
Dim status As Long
Dim count As Long
Dim componentToMove As SldWorks.Component2
Dim componentsToMove() As Object
Dim i As Long
Dim retVal As Boolean
Sub Main()
       

    Set swApp = Application.SldWorks

    'Open assembly document
    swApp.OpenDoc6 "C:\Users\Public\Documents\SOLIDWORKS\SOLIDWORKS 2017\tutorial\motionstudies\valve_cam.sldasm", swDocASSEMBLY, swOpenDocOptions_Silent, "", errors, warnings
    Set modelDoc2 = swApp.ActiveDoc
    Set assemblyDoc = modelDoc2

    'Select and get the two valve-related components to move to the new folder
    Set modelDocExt = modelDoc2.Extension
    Set selectionMgr = modelDoc2.SelectionManager
    status = modelDocExt.SelectByID2("valve-1@valve_cam", "COMPONENT", 0, 0, 0, True, 0, Nothing, 0)
    Set selObj = selectionMgr.GetSelectedObject6(1, -1)
    status = modelDocExt.SelectByID2("valve_guide-1@valve_cam", "COMPONENT", 0, 0, 0, True, 0, Nothing, 0)
    Set selObj = selectionMgr.GetSelectedObject6(2, -1)
    count = selectionMgr.GetSelectedObjectCount2(0)
    ReDim componentsToMove(count - 1)
    For i = 0 To count - 1
        Set componentToMove = selectionMgr.GetSelectedObjectsComponent4(i + 1, 0)
        Set componentsToMove(i) = componentToMove
    Next

    'Create the folder where to move the selected components
    Set featureMgr = modelDoc2.FeatureManager
    Set feature = featureMgr.InsertFeatureTreeFolder2(swFeatureTreeFolder_EmptyBefore)
    Set feature = assemblyDoc.FeatureByName("Folder1")

    'Move the selected components to the new folder
    retVal = assemblyDoc.ReorderComponents(componentsToMove, feature, swReorderComponents_LastInFolder)

    status = modelDocExt.SelectByID2("valve-1@valve_cam", "COMPONENT", 0, 0, 0, True, 0, Nothing, 0)
    Set feat = selectionMgr.GetSelectedObject6(1, -1)

    Set featureMgr = modelDoc2.FeatureManager
    Set folderFeat = featureMgr.FeatureFolderLocation(feat)
       

    Debug.Print "Component valve-1@valve_cam folder feature: " & folderFeat.Name

End Sub