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InsertWrapFeature2 Method (IFeatureManager)

Inserts a wrap feature.

.NET Syntax

Visual Basic (Declaration) 
Function InsertWrapFeature2( _
   ByVal Type As System.Integer, _
   ByVal Thickness As System.Double, _
   ByVal ReverseDir As System.Boolean, _
   ByVal Method As System.Integer, _
   ByVal MeshFactor As System.Integer _
) As Feature
Visual Basic (Usage) 
Dim instance As IFeatureManager
Dim Type As System.Integer
Dim Thickness As System.Double
Dim ReverseDir As System.Boolean
Dim Method As System.Integer
Dim MeshFactor As System.Integer
Dim value As Feature
value = instance.InsertWrapFeature2(Type, Thickness, ReverseDir, Method, MeshFactor)
Feature InsertWrapFeature2( 
   System.int Type,
   System.double Thickness,
   System.bool ReverseDir,
   System.int Method,
   System.int MeshFactor
Feature^ InsertWrapFeature2( 
&   System.int Type,
&   System.double Thickness,
&   System.bool ReverseDir,
&   System.int Method,
&   System.int MeshFactor


Type of wrap as defined in swWrapSketchType_e
Thickness; 0.00001 (thinnest) - 10000 (thickest)

True to reverse the direction of the wrap, false to not

Type of wrap method as defined in swWrapMethods_e

Accuracy of flattened triangle mesh; 1 (lowest) - 10 (highest) 

Return Value

Wrap feature



To select... Use IModelDocExtension::SelectByID2 or IModelDocExtension::SelectByRay and specify a Mark of...
One or more faces on which to place the wrap feature 1

Pull direction entity if Type is:

  • swWrapSketchType_e.swWrapSketchType_Emboss
    - or -
  • swWrapSketchType_e.swWrapSketchType_Engrave

For a line or linear edge, the pull direction is the direction of the selected entity. For a plane, the pull direction is normal to the plane. To wrap the sketch normal to the sketch plane, do not select a pull direction entity.

2D sketch containing no open contours; 3D sketches are not supported 4

NOTE: The difference between this method and the now obsolete IFeatureManager::InsertWrapFeature is that IFeatureManager::InsertWrapFeature2 can create a wrap feature on one or more faces and IFeatureManager::InsertWrapFeature creates a wrap feature on one face only.


See Also


SOLIDWORKS 2017 FCS, Revision Number 25.0

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