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Trim Sketch Entities Example (C#)

This example shows how to trim sketch entities.

//-----------------------------------------
// Preconditions: Run the macro.
//
// Postconditions:
// 1. Opens a new part document.
// 2. Sketches some lines.
// 3. Examine the sketch, then press
//    F5.
// 4. Selects two lines and trims them
//    to a corner.
// 5. Examine the sketch to verify.
//----------------------------------------- 
using SolidWorks.Interop.sldworks;
using SolidWorks.Interop.swconst;
using System.Runtime.InteropServices;
using System;
 
namespace SketchTrimCSharp.csproj
{
    partial class SolidWorksMacro
    {
        public void Main()
        {
            ModelDoc2 swModel = default(ModelDoc2);
            ModelDocExtension swModelDocExt = default(ModelDocExtension);
            SketchManager swSketchMgr = default(SketchManager);
            SketchSegment swSketchSegment = default(SketchSegment);
            bool status = false;
 
            swModel = (ModelDoc2)swApp.NewDocument("C:\\ProgramData\\SOLIDWORKS\\SOLIDWORKS 2013\\templates\\Part.prtdot", 0, 0, 0);
            swModelDocExt = (ModelDocExtension)swModel.Extension;
            swSketchMgr = (SketchManager)swModel.SketchManager;
 
            // Create sketch of lines
            status = swModelDocExt.SelectByID2("Front Plane""PLANE", 0, 0, 0, false, 0, null, 0);
            swSketchMgr.InsertSketch(true);
            swModel.ClearSelection2(true);
            swSketchSegment = (SketchSegment)swSketchMgr.CreateLine(-0.055275, 0.03236, 0.0, 0.027405, 0.03236, 0.0);
            swSketchSegment = (SketchSegment)swSketchMgr.CreateLine(0.027405, 0.03236, 0.0, 0.027405, -0.026476, 0.0);
            swSketchSegment = (SketchSegment)swSketchMgr.CreateLine(0.027405, -0.026476, 0.0, -0.055275, -0.026476, 0.0);
            swSketchSegment = (SketchSegment)swSketchMgr.CreateLine(-0.055275, -0.026476, 0.0, -0.055275, -0.070758, 0.0);
            swSketchSegment = (SketchSegment)swSketchMgr.CreateLine(-0.055275, -0.070758, 0.0, 0.027405, -0.070758, 0.0);
            swSketchSegment = (SketchSegment)swSketchMgr.CreateLine(0.027405, -0.070758, 0.0, 0.076642, 0.03236, 0.0);
            swModel.ClearSelection2(true);
 
            System.Diagnostics.Debugger.Break();
            // Examine the sketch before trimming
            // the selected lines to a corner
            // Press F5
            // Select two lines to trim to a corner
 
            status = swModelDocExt.SelectByID2("Line6""SKETCHSEGMENT", 0.0391723509933775, -0.0466042594822396, 0, true, 0, null, 0);
            status = swModelDocExt.SelectByID2("Line3""SKETCHSEGMENT", 0.0193539283564118, -0.0264761739915713, 0, true, 0, null, 0);
            status = swSketchMgr.SketchTrim((int)swSketchTrimChoice_e.swSketchTrimCorner, 0, 0, 0);
            swModel.ClearSelection2(true);
 
        }
 
        /// <summary>
        /// The SldWorks swApp variable is pre-assigned for you.
        /// </summary>
 
        public SldWorks swApp;
 
    }
}


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