In a section view in a part or assembly document, the model is displayed as if cut by planes and faces that you specify, to show the internal construction of the model.
You can:
- Select bodies or components to include in or exclude from section views.
- Toggle the view off and on. The section view state is retained, even when you save and reopen the document.
- Show or hide a section cap. If you show a section cap, you can choose whether it displays with its own color.
- Select the faces, edges, and vertices created by a section view.
- Select one or more zones formed by the bounding box created by the selected section planes or faces and the bounding box of the model.
- Save the section view as a named view in the part or assembly document or as an annotation view for use in drawing documents.
You can also create section views in drawings.
You cannot apply a section view to a mesh body.
Zebra stripes are not available with an active section view.
To create a section view:
-
In a part or assembly document, click Section View
(View toolbar) or .
- In the Section View PropertyManager, under Section Method, select one of the following:
| Option |
Description |
|---|
| Planar |
Define a section view by selecting one, two, or three planes or planar faces. |
|---|
| Zonal |
Define a section view by selecting one or more zones. Zones are defined by the intersection of the selected plane or face and the bounding box of the model. Use Zonal to create section views where multiple areas of the model are cut away. |
|---|
- In the Section View PropertyManager, under Section Option, select how the section offset is calculated:
- Reference Plane
Values are calculated normal to the currently-oriented section plane.
- Selected Plane
Values are calculated normal to the plane you select in Section 1.
- Under Section 1, select a plane.
- Set the offset distance and rotation.
If the section method is Zonal, you are cannot reverse the section direction.
- To section the model with additional planes or faces, select Section 2 and Section 3 and set the properties.
Section 3 is unavailable until Section 2 has been selected.
- Click Selected bodies or Selected components to create a section view of a part or an assembly, respectively.
- Under Selected components, select one of the following:
| Option |
Description |
|---|
| Exclude selected |
The selected bodies or components are not sectioned. All other bodies or components are sectioned. |
|---|
| Include selected |
The selected bodies or components are sectioned. Other bodies or components are not sectioned. |
|---|
- Select Enable selection plane.
A selection plane appears to help you select components that are not visible in the model or in the sectioned area. The triad, in the center of the selection plane, controls the position and angle of the selection plane.
- Drag the center ball of the triad to view hidden components.
- If you selected Zonal under Section Method, in the graphics area, select one or more intersection zones.
- Click Preview to show the graphics-only preview of the section based on the section plane location and the components or bodies that you select.
Preview hides the section plane, reference plane and face outlines, and the selection plane.
- Click
. To return the model to full view, click
Section View again.
To edit the section view, right-click in the graphics area and select Section View Properties.