Add Reference Dimension Example (C#)
This example shows how to add a reference dimension to a model in a
drawing.
//---------------------------------------------------------------
// Preconditions:
// 1. Verify that the specified drawing document to open exists.
// 2. Open the Immediate window.
//
// Postconditions:
// 1. Opens the specified drawing document.
// 2. Activates a drawing view, selects an edge on the model, and
// creates a dimension.
// 3. Prints to the Immediate window whether the dimension
// is a reference dimension.
// 4. Examine the Immediate window.
//
// NOTE: Because the drawing document is used elsewhere, do not
// save any changes.
//---------------------------------------------------------------
using SolidWorks.Interop.sldworks;
using SolidWorks.Interop.swconst;
using System.Runtime.InteropServices;
using System;
using System.Diagnostics;
namespace ISReferenceDimCSharp.csproj
{
public partial class SolidWorksMacro
{
public void Main()
{
ModelDoc2 swModel = default(ModelDoc2);
DrawingDoc swDrawingDoc = default(DrawingDoc);
ModelDocExtension swModelDocExt = default(ModelDocExtension);
DisplayDimension swDisplayDimension = default(DisplayDimension);
string fileName = null;
bool status = false;
int errors = 0;
int warnings = 0;
fileName = "C:\\Users\\Public\\Documents\\SOLIDWORKS\\SOLIDWORKS 2018\\samples\\tutorial\\api\\cylinder20.SLDDRW";
swModel = (ModelDoc2)swApp.OpenDoc6(fileName, (int)swDocumentTypes_e.swDocDRAWING, (int)swOpenDocOptions_e.swOpenDocOptions_Silent, "", ref errors, ref warnings);
swDrawingDoc = (DrawingDoc)swModel;
swModelDocExt = (ModelDocExtension)swModel.Extension;
status = swDrawingDoc.ActivateView("Drawing View1");
status = swModelDocExt.SelectByID2("", "EDGE", 0.512187343878665, 0.498697444621999, 249.953027873291, false, 0, null, 0);
swDisplayDimension = (DisplayDimension)swModelDocExt.AddDimension(0.698326046410311, 0.699228314873418, 0, (int)swSmartDimensionDirection_e.swSmartDimensionDirection_Up);
Debug.Print("Is reference dimension? " + swDisplayDimension.IsReferenceDim());
swModel.ClearSelection2(true);
}
/// <summary>
/// The SldWorks swApp variable is pre-assigned for you.
/// </summary>
public SldWorks swApp;
}
}