Create Drawing Sheet Zones Example (VBA)

This example shows how to create a drawing sheet with zones, modify the zones in the drawing sheet, and insert a revision table.

'-----------------------------------------------------------------------------
' Preconditions:
' 1. Verify that the specified model document and templates exist.
' 2. Open an Immediate window.
'
' Postconditions:
' 1. Creates a new sheet named Test with four zones.
' 2. Inspect the graphics area.
' 3. Press F5.
' 4. Modifies Test to contain nine zones.
' 5. Creates Revision Table1.
' 6. Adds a revision row to the table.
' 7. Inspect the FeatureManager design tree, the graphics area, and the
'    Immediate window.
'
' NOTE: Because the model is used elsewhere, do not save changes to it.
'---------------------------------------------------------------------------

Option Explicit

Dim swApp As SldWorks.SldWorks
Dim swDraw As SldWorks.DrawingDoc
Dim currentsheet As SldWorks.Sheet
Dim swModel As SldWorks.ModelDoc2
Dim revTableAnno As SldWorks.RevisionTableAnnotation
Dim boolstatus As Boolean
Dim longstatus As Long, longwarnings As Long

Sub main()

    Set swApp = Application.SldWorks
    Set swModel = swApp.OpenDoc6("C:\Users\Public\Documents\SOLIDWORKS\SOLIDWORKS 2018\samples\tutorial\api\assem20.slddrw", 3, 0, "", longstatus, longwarnings)
    swApp.ActivateDoc2 "assem20 - Sheet1", False, longstatus
    Set swModel = swApp.ActiveDoc
    Set swDraw = swModel
   

    boolstatus = swModel.Extension.SetUserPreferenceToggle(swUserPreferenceToggle_e.swShowZoneLines, 0, True)
    boolstatus = swModel.Extension.SetUserPreferenceInteger(swUserPreferenceIntegerValue_e.swRevisionTableMultipleSheetStyle, 0, swRevisionTableMultipleSheetStyle_e.swRevisionTable_Independent)
   

    If (swDraw Is Nothing) Then
        MsgBox " Please open a drawing document. "
        End
    End If
   

    Set currentsheet = swDraw.GetCurrentSheet
    swDraw.ActivateSheet (currentsheet.GetName)
   

    ' Create sheet, Test, with 4 zones
    boolstatus = swDraw.NewSheet4("Test", swDwgPaperAsize, swDwgTemplateAsize, 1, 1, True, "", 0, 0, "", 0.5, 0.5, 0.5, 0.5, 2, 2)
   

    Stop
  

    boolstatus = swModel.Extension.SelectByID2("Sheet Format2", "SHEET", 0, 0, 0, False, 0, Nothing, 0)
    swModel.EditTemplate
    swModel.EditSketch
    swModel.ClearSelection2 True
    boolstatus = swModel.Extension.SelectByID2("Sheet Format2", "SHEET", 8.12585524728589E-02, 0.139959974668275, 0, False, 0, Nothing, 0)
 

    ' Modify Test to have 9 zones
    boolstatus = swDraw.SetupSheet6("Test", swDwgPapersUserDefined, swDwgTemplateCustom, 1, 1, True, "C:\Program Files\SOLIDWORKS Corp\SOLIDWORKS\lang\english\sheetformat\a - landscape.slddrt", 0.2794, 0.2159, "Default", False, 0.5, 0.5, 0.5, 0.5, 3, 3)
   
    swModel.EditSheet
    swModel.EditSketch
    swModel.ForceRebuild3 True
 

    Set currentsheet = swDraw.GetCurrentSheet
    swDraw.ActivateSheet (currentsheet.GetName)
   

    ' Insert a revision table and add a revision row
    Set revTableAnno = currentsheet.InsertRevisionTable2(True, 0#, 0#, swBOMConfigurationAnchor_TopLeft, "C:\Program Files\SOLIDWORKS Corp\SOLIDWORKS\lang\English\standard revision block.sldrevtbt", swRevisionTable_CircleSymbol, True)
    Debug.Print "Revision table annotation"
    Debug.Print "  New revision: " & revTableAnno.AddRevision("A")
    Debug.Print "  Current revision: " & revTableAnno.CurrentRevision
   

    Dim revTableFeat As SldWorks.RevisionTableFeature
    Set revTableFeat = revTableAnno.RevisionTableFeature
    Debug.Print "Revision table feature"
    Debug.Print "  Number of revision table annotations: " & revTableFeat.GetTableAnnotationCount
   

    Dim feat As SldWorks.Feature
    Set feat = revTableFeat.GetFeature
    Debug.Print "Feature: " & feat.Name
   

End Sub