Create a Structural-Member Group Example (VB.NET)

This example shows how to create structural-member groups for weldment features.

' ----------------------------------------------------------------------
' Preconditions:
' 1. Ensure that the specified weldment profile and path exist.
' 2. If necessary, modify the path in both calls to
'    InsertStructuralWeldment3.
'
' Postconditions:
' 1. Two structural-member features are created.
' 2. Each feature consists of one structural-member group of two
'    sketch segments.
' 3. Inspect the Immediate Window for information.
'----------------------------------------------------------------------------

Imports SolidWorks.Interop.sldworks

Imports SolidWorks.Interop.swconst

Imports System

Imports System.Diagnostics

Partial Class SolidWorksMacro

    Dim Part As ModelDoc2

    Dim boolstatus As Boolean

    Dim FeatMgr As FeatureManager

    Dim SelMgr As SelectionMgr

    Dim swWeldFeat As Feature

    Dim swWeldFeatData As StructuralMemberFeatureData

 

    Public Sub Main()

        Dim MacroFolder As String

        MacroFolder = swApp.GetCurrentMacroPathFolder()

        swApp.SetCurrentWorkingDirectory(MacroFolder)

        Dim Template As String

        Template = swApp.GetUserPreferenceStringValue(swUserPreferenceStringValue_e.swDefaultTemplatePart)

        Part = swApp.NewDocument(Template, 0, 0, 0)

        FeatMgr = Part.FeatureManager

        SelMgr = Part.SelectionManager

        Part.ClearSelection2(True)

        Dim vSkLines As Object

        vSkLines = Part.SketchManager.CreateCornerRectangle(-0.1872393706766, 0.1133237194389, 0, -0.07003610048208, 0.009188409684237, 0)

        Part.ClearSelection2(True)

        vSkLines = Part.SketchManager.CreateCornerRectangle(0.06513561531715, 0.03369083550887, 0, 0.1807053904567, -0.08106219210316, 0)

        Part.ClearSelection2(True)

        Part.SketchManager.InsertSketch(True)

        Part.ViewZoomtofit2()

        Dim myFeature As Feature

        myFeature = Part.FeatureManager.InsertWeldmentFeature()

        Dim Group1 As StructuralMemberGroup

        Group1 = FeatMgr.CreateStructuralMemberGroup

        Dim segments1(1) As SketchSegment

        Dim GroupArray1(0) As StructuralMemberGroup

        boolstatus = Part.Extension.SelectByID2("Line1@Sketch1", "EXTSKETCHSEGMENT", -0.1495427140733, 0.1133237194389, 0, False, 0, Nothing, 0)

        boolstatus = Part.Extension.SelectByID2("Line2@Sketch1", "EXTSKETCHSEGMENT", -0.1872393706766, 0.08238014634844, 0, True, 0, Nothing, 0)

        segments1(0) = SelMgr.GetSelectedObject6(1, 0)

        segments1(1) = SelMgr.GetSelectedObject6(2, 0)

        Group1.Segments = segments1

        GroupArray1(0) = Group1

        myFeature = Part.FeatureManager.InsertStructuralWeldment3("C:\Program Files\SOLIDWORKS Corp\SOLIDWORKS\lang\english\weldment profiles\ansi inch\c channel\3 x 5.sldlfp", 1, 0, False, GroupArray1)

        Part.ClearSelection2(True)

        Dim Group2 As StructuralMemberGroup

        Group2 = FeatMgr.CreateStructuralMemberGroup

        Dim segments2(1) As SketchSegment

        Dim GroupArray2(0) As StructuralMemberGroup

        boolstatus = Part.Extension.SelectByID2("Line5@Sketch1", "EXTSKETCHSEGMENT", 0.1185825251083, 0.03369083550887, 0, False, 0, Nothing, 0)

        boolstatus = Part.Extension.SelectByID2("Line6@Sketch1", "EXTSKETCHSEGMENT", 0.06513561531715, -0.02774616865332, 0, True, 0, Nothing, 0)

        segments2(0) = SelMgr.GetSelectedObject6(1, 0)

        segments2(1) = SelMgr.GetSelectedObject6(2, 0)

        Group2.Segments = segments2

        GroupArray2(0) = Group2

        myFeature = Part.FeatureManager.InsertStructuralWeldment3("C:\Program Files\SOLIDWORKS Corp\SOLIDWORKS\lang\english\weldment profiles\ansi inch\c channel\3 x 5.sldlfp", 1, 0, False, GroupArray2)

        Part.ClearSelection2(True)

        ' Get Group Information

        Dim Group As StructuralMemberGroup

        Dim vGroups As Object

        Dim vSegments As Object

        boolstatus = Part.Extension.SelectByID2("Structural Member1", "BODYFEATURE", 0, 0, 0, False, 0, Nothing, 0)

        swWeldFeat = SelMgr.GetSelectedObject6(1, 0)

        swWeldFeatData = swWeldFeat.GetDefinition

        swWeldFeatData.AccessSelections(Part, Nothing)

        Debug.Print("")

        Debug.Print("Groups Count : " & swWeldFeatData.GetGroupsCount)

        Debug.Print(" Feature Name : " & swWeldFeat.Name)

        vGroups = swWeldFeatData.Groups

        Dim i As Long, j As Long

        For i = LBound(vGroups) To UBound(vGroups)

            Group = vGroups(i)

            Debug.Print(" Segment Count in Group " & i + 1 & "  : " & Group.GetSegmentsCount)

            Debug.Print(" Rotational angle for group: " + Group.Angle.ToString())

            vSegments = Group.Segments

            For j = LBound(vSegments) To UBound(vSegments)

                vSegments(j).Select(False)

            Next j

        Next i

        swWeldFeatData.ReleaseSelectionAccess()

        boolstatus = Part.Extension.SelectByID2("Structural Member2", "BODYFEATURE", 0, 0, 0, False, 0, Nothing, 0)

        swWeldFeat = SelMgr.GetSelectedObject6(1, 0)

        swWeldFeatData = swWeldFeat.GetDefinition

        swWeldFeatData.AccessSelections(Part, Nothing)

        Debug.Print("")

        Debug.Print("Groups Count : " & swWeldFeatData.GetGroupsCount)

        Debug.Print(" Feature Name : " & swWeldFeat.Name)

        vGroups = swWeldFeatData.Groups

        For i = LBound(vGroups) To UBound(vGroups)

            Group = vGroups(i)

            Debug.Print(" Segment Count in Group " & i + 1 & "  : " & Group.GetSegmentsCount)

            Debug.Print(" Rotational angle for group: " + Group.Angle.ToString())

            vSegments = Group.Segments

            For j = LBound(vSegments) To UBound(vSegments)

                vSegments(j).Select(False)

            Next j

        Next i

        swWeldFeatData.ReleaseSelectionAccess()

    End Sub

    

    Public swApp As SldWorks

End Class