Create and Modify Move Face Feature Example (C#)

This example shows how to create a Move Face feature by translating a face on a part.

//---------------------------------------------------------------------------
// Preconditions: Verify that the specified part exists.
//
// Postconditions: 
// 1. Creates Move Face1 in the FeatureManager design tree.
// 2. Modifies the translation parameters of Move Face1. 
//
// NOTE: Because the part is used elsewhere, do not save any changes.
//---------------------------------------------------------------------------
using Microsoft.VisualBasic;
using System;
using System.Collections;
using System.Collections.Generic;
using System.Data;
using System.Diagnostics;
using SolidWorks.Interop.sldworks;
using SolidWorks.Interop.swconst;
using System.Runtime.InteropServices;
namespace InsertMoveFace3_CSharp.csproj
{
    partial class SolidWorksMacro
    {
 
        ModelDoc2 swModel;
        ModelDocExtension swModelDocExt;
        FeatureManager swFeatMgr;
        Feature swFeat;
        MoveFaceFeatureData swMoveFaceFeat;
        object transParams;
        bool boolstatus;
        double[] triadParams = new double[3];
        int fileerror;
 
        int filewarning;
 
        public void Main()
        {
            // Open the SOLIDWORKS document
            swApp.OpenDoc6("C:\\Users\\Public\\Documents\\SOLIDWORKS\\SOLIDWORKS 2018\\samples\\tutorial\\assemblymates\\knee.sldprt", (int)swDocumentTypes_e.swDocPART, (int)swOpenDocOptions_e.swOpenDocOptions_Silent, "", ref fileerror, ref filewarning);
 
            swModel = (ModelDoc2)swApp.ActiveDoc;
            swModelDocExt = swModel.Extension;
            swFeatMgr = swModel.FeatureManager;
 
            // Translation parameters
            triadParams[0] = 0;
            triadParams[1] = 0.05;
            triadParams[2] = 0;
 
            transParams = triadParams;
 
            // Select face to move
            boolstatus = swModel.Extension.SelectByID2("", "FACE", 0.04239074672171, 0.01587499999999, 0.3283508339712, false, 1, null, 0);
 
            // Create the Move Face feature by
            // translating the selected face
            swFeat = (Feature)swFeatMgr.InsertMoveFace3((int)swMoveFaceType_e.swMoveFaceTypeTranslate, false, 0, 0, (transParams), null, (int)swEndConditions_e.swEndCondBlind, 0);
 
            // Modify the Move Face feature
            swMoveFaceFeat = (MoveFaceFeatureData)swFeat.GetDefinition();
 
            // Roll back the Move Face feature
            swMoveFaceFeat.AccessSelections(swModel, null);
 
            triadParams[0] = 0;
            triadParams[1] = 0.1;
            triadParams[2] = 0;
 
            transParams = triadParams;
 
            swMoveFaceFeat.TriadTranslationParameters = (transParams);
 
            // Roll back the part with the modified Move Face feature
            swFeat.ModifyDefinition(swMoveFaceFeat, swModel, null);
 
        }
 
        public SldWorks swApp;
 
    }
}