Hide Table of Contents

Get Intersect Feature Data Example (VBA)

This example shows how to create an intersect feature and get its data.

' Preconditions:
' 1. Open a part that contains the following intersecting features:
'    * Boss-Extrude1
'    * Boss-Extrude2
'    * Boss-Extrude3
'    * Boss-Extrude4
'    * Surface-Extrude1
' 2. Open an Immediate window.
' 3. Multi-select Surface-Extrude1, Boss-Extrude3, and Boss-Extrude4 in the
'    FeatureManager design tree and press F5.
' Postconditions:
' 1. When the macro stops, hide Boss-Extrude3 and Boss-Extrude4 in the
'    FeatureManager design tree.
' 2. Press F5.
' 3. When the macro stops, inspect the blue intersect regions.
' 4. Press F5.
' 5. Inspect the Immediate window.
' 6. Right-click Intersect1 in the FeatureManager design tree and click
'    Roll Forward.
' NOTE: Because the model is used elsewhere, do not save changes.
' ---------------------------------------------------------------------------


Option Explicit

Dim swApp As SldWorks.SldWorks
Dim swModel As SldWorks.ModelDoc2
Dim swFeat As SldWorks.Feature
Dim swFeatMgr As SldWorks.FeatureManager
Dim featData As SldWorks.IntersectFeatureData
Dim intStatus As Long

Sub main()

    Set swApp = Application.SldWorks
    Set swModel = swApp.ActiveDoc
    Set swFeatMgr = swModel.FeatureManager

    Dim vResultingBodies As Variant

    vResultingBodies = swFeatMgr.PreIntersect(False) 'Do not cap planar surface openings of intersect feature
    swModel.ClearSelection2 True

    Dim i As Integer
    Dim swBody As Body2

    Stop 'Hide Boss-Extrude4 and Boss-Extrude3 to expose the intersect regions

    Debug.Print ""
    'Color the intersect regions blue
    For i = 0 To UBound(vResultingBodies)
        Set swBody = vResultingBodies(i)
        Debug.Print "Intersect region " & i + 1 & " is a temporary body? " & swBody.IsTemporaryBody
        intStatus = swBody.Display3(swModel, 16711680, swTempBodySelectOptionNone)
        Debug.Print "Intersect region " & i + 1 & " is displayed (0 = yes)? " & intStatus

    Stop 'Observe the intersect regions

    Dim intToExclude As Variant
    Dim boolArr(3) As Boolean
    boolArr(0) = False
    boolArr(1) = True 'Exclude region, vResultingBodies(2), from the intersect feature
    boolArr(2) = False
    boolArr(3) = False
    intToExclude = boolArr
    Set swFeat = swFeatMgr.PostIntersect(intToExclude, True, False)

    Debug.Print "Feature name = " & swFeat.Name
    Set featData = swFeat.GetDefinition

    Debug.Print "Merge touching regions into one body? " & featData.Merge
    Debug.Print "Consume surfaces? " & featData.Consume
    Debug.Print "Cap planar openings on surfaces? " & featData.CapPlanar

    Debug.Print "Number of solids, surfaces, or planes used to create the intersect feature: " & featData.GetIntersectionsToolsCount
    Debug.Print "Number of intersect regions: " & featData.GetIntersectionsCount

End Sub

Provide feedback on this topic

SOLIDWORKS welcomes your feedback concerning the presentation, accuracy, and thoroughness of the documentation. Use the form below to send your comments and suggestions about this topic directly to our documentation team. The documentation team cannot answer technical support questions. Click here for information about technical support.

* Required

Subject:   Feedback on Help Topics
Page:   Get Intersect Feature Data Example (VBA)
*   I acknowledge I have read and I hereby accept the privacy policy under which my Personal Data will be used by Dassault Systèmes

Print Topic

Select the scope of content to print:


We have detected you are using a browser version older than Internet Explorer 7. For optimized display, we suggest upgrading your browser to Internet Explorer 7 or newer.

 Never show this message again

Web Help Content Version: API Help (English only) 2018 SP05

To disable Web help from within SOLIDWORKS and use local help instead, click Help > Use SOLIDWORKS Web Help.

To report problems encountered with the Web help interface and search, contact your local support representative. To provide feedback on individual help topics, use the “Feedback on this topic” link on the individual topic page.