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Get Solid-fill Hatch Information Example (VBA)

This example shows how to get information about solid-fill hatches in a detail view in the current drawing sheet.

'-----------------------------------------------------------------------
' Preconditions:
' 1. Open public_documents\introsw\bolt-assembly.slddrw.
' 2. Verify that c:\temp exists.
' 3. Create a detail view of Section View A-A:
'    a. Click Insert > Drawing View > Detail.
'    b. Sketch the profile for the detail view of Section View A-A.
'    c. Move the pointer while dragging drawing view. When the view
'       is where you want it to be, click to place the view.
'    d. Click OK to close the Detail View PropertyManager page.
' 4. Right-click the detail view in the drawing to open the
'    Area Hatch/Fill PropertyManager page.
'    a. Clear the Material crosshatch check box.
'    b. Select Solid.
'    c. Click OK.
'
' Postconditions:
' 1. Traverses the drawing views.
' 2. Gets data about the solid-fill hatches in the detail view.
' 3. Open c:\temp\SolidFillData.txt in a text editor and examine the
'    contents of the file.
'
' NOTE: Because the drawing is used elsewhere, do not save changes.
'-----------------------------------------------------------------------
Option Explicit
Dim swApp As SldWorks.SldWorks
Dim swModel As SldWorks.ModelDoc2
Dim swDrawing As SldWorks.DrawingDoc
Dim swSheet As SldWorks.Sheet
Dim swView As SldWorks.View
Dim nbrSolidFillHatches As Long
Dim ArraySize As Long
Dim i As Long
Dim boundaryData As Variant
Sub main()
    Set swApp = Application.SldWorks
    Set swModel = swApp.ActiveDoc
    Set swDrawing = swModel    
    ' Open output file for solid-fill data
    Open "c:\temp\SolidFillData.txt" For Output As #1    
    ' Get drawing sheet
    Set swSheet = swDrawing.GetCurrentSheet    
    ' Get name of drawing sheet
    Write #1, "  Number of drawing views on drawing sheet: " & swDrawing.GetViewCount    
    ' First view is the current drawing sheet
    Set swView = swDrawing.GetFirstView
    Write #1, "    First drawing view is the current drawing sheet, so..."    
    ' Get first drawing view on drawing sheet
    Set swView = swView.GetNextView
    nbrSolidFillHatches = 0
    ArraySize = 0    
    While Not swView Is Nothing
        Write #1, "        Get next drawing view on drawing sheet..."
        Write #1, "            View name: " & swView.Name
        nbrSolidFillHatches = swView.GetSolidHatchCount(ArraySize)
        Write #1, "            Number of solid-fill hatches in this view: " & nbrSolidFillHatches
        Write #1, "            Size of array for the boundary data for the solid-fill hatches: " & ArraySize
        If ArraySize > 0 Then
            boundaryData = swView.GetSolidHatchInfo
            Write #1, "                          Is the loop an outer loop (first)? " & boundaryData(0)
            Write #1, "                          Number of polylines in loop: " & boundaryData(1)
            Write #1, "                          Type ( 0 = polyline; 1 = arc or circle): " & boundaryData(2)
            Write #1, "                          Size of geometric data array (will be 0 if Type = 0): " & boundaryData(3)
            Write #1, "                              See IView::GetSolidHatchInfo's API Help topic for descriptions of these array elements: "
            For i = 4 To ArraySize - 1
                Write #1, "                                            Boundary data, array element " & i & ": " & boundaryData(i)
            Next i
        End If
        ' Get next drawing view
        Set swView = swView.GetNextView
    Wend    
    ' Close c:\temp\SolidFillData.txt
    Close #1
End Sub


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