Hide Table of Contents

Insert Hole Table Example (C#)

This example shows how to insert a hole table in a drawing.

// Preconditions: Verify that the part to open and drawing template exist.
// Postconditions: 
// 1. Opens the part and creates a drawing of it.
// 2. Inserts a hole table of the part in the drawing.
// 3. Examine the hole table in the drawing.
// NOTE: Because the part is used elsewhere, do not save changes.
// ---------------------------------------------------------------------------
using SolidWorks.Interop.sldworks;
using SolidWorks.Interop.swconst;
using System;
namespace Macro1CSharp.csproj
    partial class SolidWorksMacro
        ModelDoc2 Part;
        DrawingDoc Drawing;
        bool boolstatus;
        public void Main()
            DocumentSpecification spec = (DocumentSpecification)swApp.GetOpenDocSpec("C:\\Users\\Public\\Documents\\SOLIDWORKS\\SOLIDWORKS 2018\\samples\\tutorial\\api\\cover_datum.sldprt");
            Part = (ModelDoc2)swApp.OpenDoc7(spec);
            Drawing = (DrawingDoc)swApp.NewDocument("C:\\ProgramData\\SOLIDWORKS\\SOLIDWORKS 2016\\templates\\Drawing.drwdot", 2, 0.2794, 0.4318);
            Part = (ModelDoc2)Drawing;
            boolstatus = Part.Extension.SelectByID2("Sheet1""SHEET", 0.39237, 0.5218942019544, 0, false, 0, null, 0);
            boolstatus = Drawing.Create3rdAngleViews2("C:\\Users\\Public\\Documents\\SOLIDWORKS\\SOLIDWORKS 2018\\samples\\tutorial\\api\\cover_datum.sldprt");
            boolstatus = Drawing.ActivateView("Drawing View1");
            //Select a vertex in the drawing view to be the origin of all datums in the table
            //All XLOC and YLOC table column values will be relative to this datum origin
            boolstatus = Part.Extension.SelectByID2("""VERTEX", 0.117324728174898, 0.108554228680764, -500.0075, true, 1, null, 0);
            //Select a face that contains the holes that will be annotated in the table
            boolstatus = Part.Extension.SelectByID2("""FACE", 0.090728339186173, 0.119052803281577, -500.0075, true, 2, null, 0);
            View myView = null;
            SelectionMgr selMgr = null;
            selMgr = (SelectionMgr)Part.SelectionManager;
            myView = selMgr.GetSelectedObjectsDrawingView2(1, -1);
            HoleTableAnnotation myHoleTable = null;
            //Insert a hole table
            //anchored with its top left corner at x-coordinate = 0.07m and y-coordinate = 0.175m,
            //with starting datum tag "A",
            //using hole table template: standard hole table--letters.sldholtbt
            myHoleTable = (HoleTableAnnotation)myView.InsertHoleTable2(false, 0.153019881817662, -3.77259107537343E-02, (int)swBOMConfigurationAnchorType_e.swBOMConfigurationAnchor_TopLeft, "A""C:\\Program Files\\SolidWorks Corp\\SOLIDWORKS\\lang\\english\\standard hole table--letters.sldholtbt");
            boolstatus = Drawing.ActivateSheet("Sheet1");
        public SldWorks swApp;

Provide feedback on this topic

SOLIDWORKS welcomes your feedback concerning the presentation, accuracy, and thoroughness of the documentation. Use the form below to send your comments and suggestions about this topic directly to our documentation team. The documentation team cannot answer technical support questions. Click here for information about technical support.

* Required

Subject:   Feedback on Help Topics
Page:   Insert Hole Table Example (C#)
*   I acknowledge I have read and I hereby accept the privacy policy under which my Personal Data will be used by Dassault Systèmes

Print Topic

Select the scope of content to print:


We have detected you are using a browser version older than Internet Explorer 7. For optimized display, we suggest upgrading your browser to Internet Explorer 7 or newer.

 Never show this message again

Web Help Content Version: API Help (English only) 2018 SP05

To disable Web help from within SOLIDWORKS and use local help instead, click Help > Use SOLIDWORKS Web Help.

To report problems encountered with the Web help interface and search, contact your local support representative. To provide feedback on individual help topics, use the “Feedback on this topic” link on the individual topic page.