Open an Assembly in Large Design Review Mode Example (C#)
This example shows how to open an assembly in Large Design Review mode.
//----------------------------------------------------------------------------
// Preconditions:
// 1. Verify that the specified assembly to open in Large Design Review mode exists.
// 2. Open the Immediate window.
//
// Postconditions:
// 1. Click OK in the Large Design Review dialog.
// 2. Opens the assembly.
// 3. Creates a section view.
// 4. Creates four snapshots in the DisplayManager:
// * Home
// * ASnap
// * Snap2
// * Snap3
// 5. Click OK in the Name Snapshot dialog.
// 6. Selects and fully resolves a component.
// 7. Inspect the Immediate window for snapshot information and inspect
// the graphics area.
//
// NOTE: Because the assembly is used elsewhere, do not save changes.
// ---------------------------------------------------------------------------
using Microsoft.VisualBasic;
using System;
using System.Collections;
using System.Collections.Generic;
using System.Data;
using System.Diagnostics;
using SolidWorks.Interop.sldworks;
using SolidWorks.Interop.swconst;
using System.Runtime.InteropServices;
namespace Macro1CSharp.csproj
{
partial class SolidWorksMacro
{
AssemblyDoc Part;
ModelDoc2 Model;
SnapShot snap;
object[] snaps;
SnapShot snap1;
SnapShot snap2;
SnapShot snap3;
int i;
bool boolstatus;
int longstatus;
int longwarnings;
public void Main()
{
string large_assembly_document;
large_assembly_document = "C:\\Users\\Public\\Documents\\SOLIDWORKS\\SOLIDWORKS 2018\\samples\\tutorial\\advdrawings\\motor casing.sldasm";
Part = (AssemblyDoc)swApp.OpenDoc6(large_assembly_document, (int)swDocumentTypes_e.swDocASSEMBLY, (int)swOpenDocOptions_e.swOpenDocOptions_ViewOnly, "", ref longstatus, ref longwarnings);
Model = (ModelDoc2)Part;
// Create section view
SectionViewData sViewData = default(SectionViewData);
sViewData = Model.ModelViewManager.CreateSectionViewData();
sViewData.FirstPlane = null;
sViewData.FirstReverseDirection = false;
sViewData.FirstOffset = -0.00508;
sViewData.FirstRotationX = 0;
sViewData.FirstRotationY = 0;
sViewData.FirstColor = 16711680;
sViewData.ShowSectionCap = true;
sViewData.KeepCapColor = true;
ModelViewManager mvmgr = default(ModelViewManager);
mvmgr = Model.ModelViewManager;
boolstatus = mvmgr.CreateSectionView(sViewData);
Model.ClearSelection2(true);
Model.ShowNamedView2("*Front", 1);
Model.ShowNamedView2("*Dimetric", 9);
// Add a named snapshot
snap1 = mvmgr.AddSnapShot("ASnap");
// Open dialog box to name the next snapshot
snap2 = mvmgr.AddSnapShot("?");
// Add a snapshot with the next default name
snap3 = mvmgr.AddSnapShot("");
snap1.Comment = "<TS> This is a comment for ASnap.";
snaps = (object[])mvmgr.GetSnapShots();
for (i = 0; i <= snaps.GetUpperBound(0); i++)
{
snap = (SnapShot)snaps[i];
snap.Activate();
Debug.Print("Snapshot name: " + snap.Name);
Debug.Print(" Comment: " + snap.Comment);
Debug.Print(" ViewID: " + snap.ViewId);
}
// Selects a component
boolstatus = Model.Extension.SelectByID2("motor casing-1@motor casing", "COMPONENT", 0, 0, 0, false, 0, null, 0);
// Fully resolve only the selected components
Part.SelectiveOpen(true, false);
}
public SldWorks swApp;
}
}