You can use Edit Assembly to edit
assemblies in Large Design Review mode. You can add and edit mates, and insert components
when you edit an assembly.
To use this functionality, open the assembly and component files
individually and then save in SOLIDWORKS 2019. Click to save all the open files at the same time.
In the FeatureManager design tree, the following features appear for top-level assemblies:
- Standard planes
- Origin
- Mates folder
- Reference geometry, read-only
- Sketches, read-only
- Component Patterns, read-only
On the
Large Design Review tab of
CommandManager, these tools are available:
You can use Move with Triad. To access
this tool, right-click a movable component and click Move
with Triad
.
You cannot insert a component by dragging it from the Task Pane or File Explorer. You
cannot copy a component using CTRL + drag or CTRL
+ C. You cannot paste a component into the assembly.
You cannot edit an assembly in Large Design Review mode if the top-level
assembly contains at least one of these features:
Belt/Chain |
Chamfer |
Circular Pattern (feature) |
Extruded Cut |
Fillet |
Hole Series |
Hole Wizard |
Linear Pattern
(feature) |
Mirror (feature) |
Revolved Cut |
Simple Hole |
Sketch Driven Pattern (feature) |
Swept Cut |
Table Driven Pattern
(feature) |
Weld Bead |
To edit assemblies in Large Design Review mode:
- Click Open
(Standard toolbar) or .
- In the dialog box, select an assembly, and then in Mode, select Large
Design Review.
- Select Edit Assembly.
- Click Open.
An eye overlay
appears on the icons of all components indicating that the assembly is in
Large Design Review mode.
To edit an assembly that is open in Large Design Review mode, right-click the
top-level assembly, and click Edit
Assembly.