Specifying Tolerances for Hole Wizard Holes

You can set values for tolerance and precision when creating Hole Wizard features.

The Type tab in the Hole Wizard PropertyManager includes Tolerance/Precision. Depending on the hole type, the PropertyManager displays options for tolerances that apply to the hole specification. This section is also available for Hole Wizard features in assemblies.

Tolerance values automatically propagate to hole callouts in drawings. If you change values in the hole callout, the values update in the part. You can also vary tolerance values for configurations.

Previously, you could only add parameters for tolerance and precision to Hole Wizard holes by manually modifying hole callouts in drawings.

To specify tolerances for Hole Wizard holes:

  1. Open system_dir:\Users\Public\Public Documents\SOLIDWORKS\SOLIDWORKS 2019\samples\whatsnew\parts\tolerance.sldprt.
  2. In the FeatureManager design tree, right-click CBORE and click Edit Feature.
  3. In the PropertyManager, on the Type tab, expand Tolerance/Precision.
  4. Under Tolerance/Precision, in Callout Value, select Thru Hole Diameter.
    1. For Tolerance Type, select Bilateral.
    2. For Maximum Variation, type 0.05mm.
    3. For Minimum Variation, type -0.02mm.
  5. Under Tolerance/Precision, in Callout Value, select CounterBore Diameter.
    1. For Tolerance Type, select Symmetric.
    2. For Maximum Variation, type 0.05mm.
    3. For Unit Precision, select .12 (Document).
  6. Click .

If you make a drawing from the part, the tolerance values display in the hole callout.