Hide Table of Contents

SOLIDWORKS API Help

Create Screw Mate Example (C#)

This example shows how to create a screw mechanical mate.

// --------------------------------------------------------------------------------
// Preconditions:
// 1. Open public_documents\samples\tutorial\api\MechanicalMates\Gearbox.sldasm.
// 2. Delete Screw2 from the Mates folder of the FeatureManager design tree.
// 
// Postconditions: Inspect the Mates folder in the FeatureManager design tree.
//
// NOTE: Because the model is used elsewhere, do not save changes.
// --------------------------------------------------------------------------------
using SolidWorks.Interop.sldworks;
using SolidWorks.Interop.swconst;
using System.Runtime.InteropServices;
using System;
 
namespace CreateScrewMate_CSharp
{
    partial class SolidWorksMacro
    {
 
        private ModelDoc2 Part;
        private AssemblyDoc swAssembly;
        private bool boolstatus;
 
 
        public void Main()
        {
 
            Part = (ModelDoc2)swApp.ActiveDoc;
            swAssembly = (AssemblyDoc)Part;
            boolstatus = Part.Extension.SelectByRay(0.00613295661213442, 0.0689560082602441, 0.0745357419147012, -0.540837135649095, -0.258416475165147, -0.800447448659875, 0.000789884801245894, 2, true, 1, 0);
            boolstatus = Part.Extension.SelectByRay(-0.000675539884355203, 0.0795322044607474, 0.0128285894949158, -0.540837135649095, -0.258416475165147, -0.800447448659875, 0.000789884801245894, 1, true, 1, 0);
 
            // Create ScrewMateFeatureData
            ScrewMateFeatureData MateData = (ScrewMateFeatureData)swAssembly.CreateMateData(17);
 
            // Set the entities To mate
            object[] EntitiesToMate = new object[2];
            EntitiesToMate[0] = ((SelectionMgr)(Part.SelectionManager)).GetSelectedObject6(1, -1);
            EntitiesToMate[1] = ((SelectionMgr)(Part.SelectionManager)).GetSelectedObject6(2, -1);
            object EntitiesToMateVar = EntitiesToMate;
            MateData.EntitiesToMate = (EntitiesToMateVar);
 
            // Set the mate revolution type
            MateData.RevolutionType = 0;
 
            // Set the mate revolution value
            MateData.RevolutionVal = 1;
 
            // Set the mate orientation direction
            MateData.Reverse = true;
 
            // Create the mate
            Feature MateFeature = (Feature)swAssembly.CreateMate(MateData);
            Part.ClearSelection2(true);
            Part.EditRebuild3();
 
        }
 
        /// <summary>
        /// The SldWorks swApp variable is pre-assigned for you.
        /// </summary>
        public SldWorks swApp;
    }
 
}

 



Provide feedback on this topic

SOLIDWORKS welcomes your feedback concerning the presentation, accuracy, and thoroughness of the documentation. Use the form below to send your comments and suggestions about this topic directly to our documentation team. The documentation team cannot answer technical support questions. Click here for information about technical support.

* Required

 
*Email:  
Subject:   Feedback on Help Topics
Page:   Create Screw Mate Example (C#)
*Comment:  
*   I acknowledge I have read and I hereby accept the privacy policy under which my Personal Data will be used by Dassault Systèmes

Print Topic

Select the scope of content to print:



x

We have detected you are using a browser version older than Internet Explorer 7. For optimized display, we suggest upgrading your browser to Internet Explorer 7 or newer.

 Never show this message again
x

Web Help Content Version: API Help (English only) 2019 SP05

To disable Web help from within SOLIDWORKS and use local help instead, click Help > Use SOLIDWORKS Web Help.

To report problems encountered with the Web help interface and search, contact your local support representative. To provide feedback on individual help topics, use the “Feedback on this topic” link on the individual topic page.