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Get Features of Multibody Sheet Metal Part Example (VB.NET)

This example shows how to get the number and names of the features in the cut-list folder in a multibody sheet metal part.

'---------------------------------------------------------------------------
' Preconditions: 
' 1. Open a multibody sheet metal part.
' 2. Open the Immediate window.
'
' Postconditions: 
' 1. Gets the number and names of the features in the cut-list folder
'    in a multibody sheet metal part.
' 2. Examine the Immediate window.
'--------------------------------------------------------------------------
Imports SolidWorks.Interop.sldworks
Imports SolidWorks.Interop.swconst
Imports System
Imports System.Diagnostics

Partial Class SolidWorksMacro
    Public Sub main()
        Dim swModel As ModelDoc2
        Dim swFeatMgr As FeatureManager
        Dim swFeat As Feature
        Dim swBodyFolder As BodyFolder
        Dim swBody As Body2
        Dim FeatType As String
        Dim FeatTypeName As String
        Dim Bodies As Object
        Dim Features As Object
        Dim i As Integer
        Dim j As Integer
        swModel = swApp.ActiveDoc
        swFeatMgr = swModel.FeatureManager
        swFeat = swModel.FirstFeature
        Do While Not swFeat Is Nothing
            FeatType = swFeat.Name
            FeatTypeName = swFeat.GetTypeName2
            Debug.Print("  " & FeatType & " [" & FeatTypeName & "]")
            If FeatTypeName = "CutListFolder" Then
                swBodyFolder = swFeat.GetSpecificFeature2
                swBodyFolder.SetAutomaticCutList(True)
                swBodyFolder.SetAutomaticUpdate(True)
                Bodies = swBodyFolder.GetBodies
                Debug.Print("    Number of bodies: " & swBodyFolder.GetBodyCount)
                Debug.Print("    Cut list type: " & swBodyFolder.GetCutListType)
               
Debug.Print("    Generate cut list automatically? " & swBodyFolder.GetAutomaticCutList)
                Debug.Print("    Automatically update cut list? " & swBodyFolder.GetAutomaticUpdate)
                For i = 0 To (swBodyFolder.GetBodyCount - 1)
                    swBody = Bodies(i)
                    Features = swBody.GetFeatures
                    Debug.Print("    Number of features in body #" & i + 1 & ": " & swBody.GetFeatureCount)
                    For j = 0 To (swBody.GetFeatureCount - 1)
                        Debug.Print("       Name of feature: " & Features(j).GetTypeName2)
                    Next j
                Next i
            End If
            swFeat = swFeat.GetNextFeature
        Loop

    End Sub

    ''' <summary>    ''' The SldWorks swApp variable is pre-assigned for you.

    ''' </summary>
    Public swApp As SldWorks

End Class



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