Modify Break Corner Feature Example (C#)
This example shows how to create and modify a break corner feature in a sheet metal
part.
//---------------------------------------------------
// Preconditions:
// 1. Verify that the specified part document exists.
// 2. Open the Immediate window.
//
// Postconditions:
// 1. Opens the specified document.
// 2. Selects a face on Edge-Flange1.
// 3. Creates a break corner feature.
// 4. Unsuppresses the flat pattern feature.
// 5. Accesses the break corner feature and
// and modifies it.
// 6. Suppresses the flat pattern feature.
// 7. Examine the graphics area and the Immediate window.
//
// NOTE: Because the part document is used elsewhere,
// do not save any changes.
//----------------------------------------------------
using SolidWorks.Interop.sldworks;
using SolidWorks.Interop.swconst;
using System.Runtime.InteropServices;
using System;
using System.Diagnostics;
namespace BreakCornerFeatureCSharp.csproj
{
public partial class SolidWorksMacro
{
public void Main()
{
ModelDoc2 swModel = default(ModelDoc2);
ModelDocExtension swModelDocExt = default(ModelDocExtension);
SelectionMgr swSelectionMgr = default(SelectionMgr);
Feature swFeature = default(Feature);
BreakCornerFeatureData swBreakCornerFeatureData = default(BreakCornerFeatureData);
string fileName = null;
bool status = false;
int errors = 0;
int warnings = 0;
fileName = "C:\\Users\\Public\\Documents\\SOLIDWORKS\\SOLIDWORKS 2018\\samples\\tutorial\\api\\sm1-remove-edges.sldprt";
swModel = (ModelDoc2)swApp.OpenDoc6(fileName, (int)swDocumentTypes_e.swDocPART, (int)swOpenDocOptions_e.swOpenDocOptions_Silent, "", ref errors, ref warnings);
swModelDocExt = (ModelDocExtension)swModel.Extension;
status = swModelDocExt.SelectByID2("", "FACE", -0.111589911985732, 0.0979999999999563, 0.0841212722518208, true, 0, null, 0);
swModel.InsertSheetMetalBreakCorner((int)swBreakCornerTypes_e.swBreakCornerTypeChamfer, 0.005);
//Select and unsuppress the flat pattern feature
status = swModelDocExt.SelectByID2("Flat-Pattern1", "BODYFEATURE", 0, 0, 0, false, 0, null, 0);
swModel.EditUnsuppress2();
swModel.ClearSelection2(true);
//Select the break corner feature
//and change some of its properties
status = swModelDocExt.SelectByID2("Break-Corner1", "BODYFEATURE", 0, 0, 0, false, 0, null, 0);
swSelectionMgr = (SelectionMgr)swModel.SelectionManager;
swFeature = (Feature)swSelectionMgr.GetSelectedObject6(1, 0);
swBreakCornerFeatureData = (BreakCornerFeatureData)swFeature.GetDefinition();
status = swBreakCornerFeatureData.AccessSelections(swModel, null);
Debug.Print("AccessSelections: " + status);
Debug.Print("");
Debug.Print(" -------------Original--------------");
Debug.Print(" CenteredOnBendLines: " + swBreakCornerFeatureData.CenteredOnBendLines);
Debug.Print(" InternalCornersOnly: " + swBreakCornerFeatureData.InternalCornersOnly);
swBreakCornerFeatureData.InternalCornersOnly = true;
swBreakCornerFeatureData.CenteredOnBendLines = true;
Debug.Print("");
Debug.Print(" -------------Modified--------------");
Debug.Print(" CenteredOnBendLines: " + swBreakCornerFeatureData.CenteredOnBendLines);
Debug.Print(" InternalCornersOnly: " + swBreakCornerFeatureData.InternalCornersOnly);
status = swFeature.ModifyDefinition(swBreakCornerFeatureData, swModel, null);
Debug.Print("");
Debug.Print("ModifyDefinition: " + status);
swModel.ClearSelection2(true);
//Select and suppress the flat pattern feature
status = swModelDocExt.SelectByID2("Flat-Pattern1", "BODYFEATURE", 0, 0, 0, false, 0, null, 0);
swModel.EditSuppress2();
swModel.ClearSelection2(true);
}
/// <summary>
/// The SldWorks swApp variable is pre-assigned for you.
/// </summary>
public SldWorks swApp;
}
}