Remove Edge from Edge Flange Feature Example (VB.NET)
This example shows how to remove an edge from an edge flange feature in a sheet
metal part.
'----------------------------------------------------------------------------
' Preconditions:
' 1. Open public_documents\samples\tutorial\api\SM1-remove-edges.sldprt.
' 2. Open the Immediate window.
'
' Postconditions:
' 1. Removes an edge from Edge-Flange1.
' 2. Examine the Immediate window.
'
' NOTE: Because the model is used elsewhere, do not save changes.
' ---------------------------------------------------------------------------
Imports SolidWorks.Interop.sldworks
Imports SolidWorks.Interop.swconst
Imports System.Runtime.InteropServices
Imports System
Imports System.Diagnostics
Partial Class SolidWorksMacro
Sub Main()
Dim swDocument As PartDoc
Dim swSelectionManager As SelectionMgr
Dim swEdgeFlangeData As EdgeFlangeFeatureData
Dim swFeature As Feature
Dim lNumEdges As Long
Dim aEdgesToRemove() As Edge
Dim lIdx As Long
Dim bStatus As Boolean
Dim lNumEdgesToRemove As Long
Dim vEdgesToRemove As Object
Dim vEdges As Object
Dim nStatus As swEdgeFlangeError_e
Dim modDocExt As ModelDocExtension
swDocument = swApp.ActiveDoc
swSelectionManager = swDocument.SelectionManager
modDocExt = swDocument.Extension
bStatus = modDocExt.SelectByID2("Edge-Flange1", "BODYFEATURE", 0, 0, 0, False, 0, Nothing, 0)
swFeature = swSelectionManager.GetSelectedObject6(1, 0)
swDocument.ClearSelection2(True)
swEdgeFlangeData = swFeature.GetDefinition
swEdgeFlangeData.AccessSelections(swDocument, Nothing)
vEdges = swEdgeFlangeData.Edges
lNumEdges = UBound(vEdges) - LBound(vEdges) + 1
Debug.Print("Number of edges in edge flange = " & swEdgeFlangeData.GetEdgeCount())
'
' Select number of edges to remove.
'
lNumEdgesToRemove = 1
vEdgesToRemove = Nothing
If (lNumEdgesToRemove >= 1) Then
ReDim aEdgesToRemove(lNumEdgesToRemove - 1)
For lIdx = 0 To (lNumEdgesToRemove - 1)
aEdgesToRemove(lIdx) = vEdges(lIdx)
Next lIdx
vEdgesToRemove = aEdgesToRemove
End If
nStatus = swEdgeFlangeData.RemoveEdges(vEdgesToRemove)
Debug.Print("Edge removal error code = " & swEdgeFlangeError2String(nStatus))
bStatus = swFeature.ModifyDefinition(swEdgeFlangeData, swDocument, Nothing)
Debug.Print("Status of modify definition = " & bStatus)
swEdgeFlangeData.AccessSelections(swDocument, Nothing)
vEdges = Nothing
vEdges = swEdgeFlangeData.Edges
If (Not IsNothing(vEdges)) Then
lNumEdges = UBound(vEdges) - LBound(vEdges) + 1
Debug.Print("Number of edges in edge flange = " & lNumEdges)
Else
Debug.Print("Number of edges in edge flange = 0")
End If
swEdgeFlangeData.ReleaseSelectionAccess()
End Sub
Private Function swEdgeFlangeError2String(ByVal nStatus As swEdgeFlangeError_e) As String
Select Case (nStatus)
Case 0
swEdgeFlangeError2String = "no error"
Case swEdgeFlangeError_e.swEdgeFlangeError_EdgeAlreadyExists
swEdgeFlangeError2String = "edge already exists"
Case swEdgeFlangeError_e.swEdgeFlangeError_EdgeNotSpecified
swEdgeFlangeError2String = "edge not specified"
Case swEdgeFlangeError_e.swEdgeFlangeError_NumberOfEdgesAndSketchesNotEqual
swEdgeFlangeError2String = "number mismatch"
Case swEdgeFlangeError_e.swEdgeFlangeError_SketchNotSpecified
swEdgeFlangeError2String = "sketch not specified"
Case Else
swEdgeFlangeError2String = "unknown error"
End Select
End Function
Public swApp As SldWorks
End Class