Function ExportToDWG2( _
   ByVal FilePath As System.String, _
   ByVal ModelName As System.String, _
   ByVal Action As System.Integer, _
   ByVal ExportToSingleFile As System.Boolean, _
   ByVal Alignment As System.Object, _
   ByVal IsXDirFlipped As System.Boolean, _
   ByVal IsYDirFlipped As System.Boolean, _
   ByVal SheetMetalOptions As System.Integer, _
   ByVal Views As System.Object _
) As System.Boolean

Dim instance As IPartDoc
Dim FilePath As System.String
Dim ModelName As System.String
Dim Action As System.Integer
Dim ExportToSingleFile As System.Boolean
Dim Alignment As System.Object
Dim IsXDirFlipped As System.Boolean
Dim IsYDirFlipped As System.Boolean
Dim SheetMetalOptions As System.Integer
Dim Views As System.Object
Dim value As System.Boolean
 
value = instance.ExportToDWG2(FilePath, ModelName, Action, ExportToSingleFile, Alignment, IsXDirFlipped, IsYDirFlipped, SheetMetalOptions, Views)

System.bool ExportToDWG2( 
   System.string FilePath,
   System.string ModelName,
   System.int Action,
   System.bool ExportToSingleFile,
   System.object Alignment,
   System.bool IsXDirFlipped,
   System.bool IsYDirFlipped,
   System.int SheetMetalOptions,
   System.object Views
)

System.bool ExportToDWG2( 
&   System.String^ FilePath,
&   System.String^ ModelName,
&   System.int Action,
&   System.bool ExportToSingleFile,
&   System.Object^ Alignment,
&   System.bool IsXDirFlipped,
&   System.bool IsYDirFlipped,
&   System.int SheetMetalOptions,
&   System.Object^ Views
) 

Parameters

FilePath

Path and file name of the exported DXF/DWG file

ModelName

Path and file name of the active part document

Action

Export action as defined in swExportToDWG_e

ExportToSingleFile

True to save as one file; false to save as multiple files

Alignment

Array of 12 double values that contain information related to output alignment

IsXDirFlipped

True to flip the x direction; false otherwise

IsYDirFlipped

True to flip the y direction; false otherwise

SheetMetalOptions

Bitmask that contains sheet metal export options; valid only if Action = swExportToDWG_e.swExportToDWG_ExportSheetMetal

Views

Array of annotation view names to export; valid only if Action = swExportToDWG_e.swExportToDWG_ExportAnnotationViews

Return Value

This method supersedes IPartDoc::IExportToDWG by:

• Adding an option to SheetMetalOptions to export a sheet metal bounding box.
• Not pre-pending the flat-pattern name to the FilePath file name of the exported DXF/DWG when ExportToSingleFile is false.

Alignment array is as follows:

Array[0], Array[1], Array[2] - x,y,z coordinates of new origin

Array[3], Array[4], Array[5] - coordinates of new x direction vector

Array[6], Array[7], Array[8] - coordinates of new y direction vector

Array[9], Array[10], Array[11] - coordinates of the vector that is normal to the selected faces or loops

The last three elements of the array are valid only if Action =swExportToDWG_e.swExportToDWG_ExportSelectedFacesOrLoops

The bitmask for SheetMetalOptions is {12 11 10 9 8 7 6 5 4 3 2 1}, where each bit is either 0 or 1 as follows:

Bit #1: 1 to export flat-pattern geometry; 0 to not

Bit #2: 1 to include hidden edges; 0 to not

Bit #3: 1 to export bend lines; 0 to not

Bit #4: 1 to include sketches; 0 to not

Bit #5: 1 to merge coplanar faces; 0 to not

Bit #6: 1 to export library features; 0 to not

Bit #7: 1 to export forming tools; 0 to not

Bit #8: 0

Bit #9: 0

Bit #10: 0

Bit #11: 0

Bit #12: 1 to export bounding box; 0 to not

For example, if you want to export:

• flat-pattern geometry, bend lines, and sketches, then Bits 1, 3, and 4 are 1, the bitmask is 0001101, and you need to set SheetMetalOptions = 2^0 + 2^2 + 2^3 = 1 + 4 + 8 = 13.
• only the bounding box, then Bit 12 is 1, the bitmask is 100000000000, and you need to set SheetMetalOptions = 2^11 = 2048.

You must select multi-body sheet-metal features (i.e., multiple flat-pattern features) before calling this method.