Belt/Chain PropertyManager
The Belt/Chain PropertyManager
appears when you create or edit a belt/chain
assembly feature.
Belt Members
Pulley components
. In the graphics area, select axes or cylindrical faces of
components you want to include in the belt and pulleys system. You can
click:
You can also click the feature
handle on a pulley to flip the belt to the other side.
Diameter of selected pulley
. This value is used in calculating the belt length and
determining the amount of relative rotation between adjacent pulleys.
By default, the measured diameter of the selected pulley is displayed.
If you override the measured value, the value you enter appears in bold
type. To revert to the measured value, enter 0.
Belt Location Plane
Belt sketch plane position
. You can select a vertex, plane, or planar face to change
the position of the belt sketch plane.
All pulleys in the feature must be parallel.
The belt sketch plane is normal to the axes of the pulleys.
Properties
Belt Length. Displays the length
of the belt. The software calculates the length of the belt based on the
positions and diameters of the pulleys. Optionally, click Driving
to specify the length of the belt and have the pulley positions adjust
(at least one pulley must have an appropriate degree of freedom).
Use belt thickness. Select to
specify a thickness for the belt. The belt curve is offset from the cylindrical
faces of the pulleys by one half the specified belt thickness.
Engage belt. Select to cause
rotation of the pulleys relative to each other.
Clear to suppress the belt mates, which enables you to reposition a pulley
without causing the other pulleys to rotate.
Create belt part. Select to
automatically create a new part containing the belt sketch and add the
part to the assembly. In the part file, use the sketch as a sweep path
to create a solid belt. If you change the pulley positions in the assembly,
the sketch updates in the belt part.