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Error Message - Dangling Geometry

Potential Error Messages

  • This sketch contains dimensions or relations to model geometry which no longer exists. Consider:

    • Deleting the dangling sketch entities (shown dashed and in dangling color)

    • Editing the model to restore the missing model geometry

Potential Reasons for These Error Messages

Dimensions or relations reference something that no longer exists or is unresolved.

Dangling Dimension Example

Dangling dimension

Potential Solution:

Dimension repaired by dragging.

 

Dangling Relation Example

Dangling relation

Potential Solution:

Relation repaired with the Display/Delete Relations tool.

Potential Fixes

Begin by repairing the first feature with an error in the FeatureManager design tree, then work down through subsequent errors. Dangling dimensions and relations are shown in a different color (default: brown) than the resolved sketch entities.

To set the color for dangling dimensions, click Tools, Options, System Options, Colors. Select Dimensions, Dangling in System Colors. Click Edit, select a color, then click OK.

  • Dimensions. Drag the dangling handle and reattach it to the correct sketch entity. If you attempt to reattach it to an invalid location, the pointer displays the symbol.

  • Relations. Drag the sketch entity to relocate a relation, or use the Display/Delete Relations tool.

    • Drag the sketch entity.

      1. Click the entity that displays the dangling handle to display the relations in the PropertyManager.

The dangling relation highlights with the same color as the related sketch entity.

      1. Drag the dangling handle to the appropriate sketch entity to transfer the relation from the missing entity to the selected entity.

    • Display/Delete Relations tool. Some relations, like a coincident relation between points, can only be repaired with the Display/Delete Relations tool.

      1. Click Display/Delete Relations on the Dimensions/Relations toolbar, or click Tools, Relations, Display/Delete.

      2. In the PropertyManager, under Relations, select Dangling in Filter to display only dangling relations in Relations .

      3. Select a relation in Relations.

      4. Under Entities,

        1. Select the entity that shows Dangling for Status.

        2. Select the entity in the graphics area for Entity to replace the one selected above to form the correct relation.

        3. Click Replace, then click OK .

Other References

SolidWorks Online Help topics:



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