Insert and Show BOM Table in Assembly (C#)

This example shows how to insert and show a BOM table in an assembly document.

//------------------------------------------------

// Preconditions: Specified file to open and BOM template exist.

//

// Postconditions:

// 1. Parts-only BOM table is inserted.

// 2. Split-circle stacked balloon, which uses the

//    BOM table item number for its upper text, is inserted

//    for the selected face.

// 3. Examine both the BOM table and stacked balloon to verify

//    the results.

//

// NOTE: Because this assembly document is used by a SolidWorks

// online tutorial, do not save any changes when

// closing the document.

//-------------------------------------------------

using SolidWorks.Interop.sldworks;

using SolidWorks.Interop.swconst;

using System;

using System.Diagnostics;

 

namespace InsertBOMTable2AssemblyCSharp.csproj

{

    partial class SolidWorksMacro

    {

        public void Main()

        {

            ModelDoc2 swModel = default(ModelDoc2);

            ModelDocExtension swModelDocExt = default(ModelDocExtension);

            BomTableAnnotation swBOMAnnotation = default(BomTableAnnotation);

            BomFeature swBOMFeature = default(BomFeature);

            Note swNote = default(Note);

            bool boolstatus = false;

            int BomType = 0;

            string Configuration = null;

            string TemplateName = null;

            int errors = 0;

            int warnings = 0;

 

            // Open assembly document

            swModel = (ModelDoc2)swApp.OpenDoc6("C:\\Program Files\\SolidWorks Corp\\SolidWorks\\samples\\tutorial\\cosmosfloxpress\\ball valve\\ball_valve.sldasm", (int)swDocumentTypes_e.swDocASSEMBLY, (int)swOpenDocOptions_e.swOpenDocOptions_Silent, "", ref errors, ref warnings);

            swModelDocExt = (ModelDocExtension)swModel.Extension;

 

            // Insert BOM table

            TemplateName = "C:\\Program Files\\SolidWorks Corp\\SolidWorks\\lang\\english\\bom-standard.sldbomtbt";

            BomType = (int)swBomType_e.swBomType_PartsOnly;

            Configuration = "Default";

            swBOMAnnotation = (BomTableAnnotation)swModelDocExt.InsertBomTable2(TemplateName, 0, 0, BomType, Configuration, false);

            swBOMFeature = (BomFeature)swBOMAnnotation.BomFeature;

 

            // Print the name of the configuration used for the BOM table

            Debug.Print("Name of configuration used for BOM table: " + swBOMFeature.Configuration);

 

            // Insert BOM balloon for the selected face, which

            // belongs to the part Side

            boolstatus = swModelDocExt.SelectByID2("", "FACE", -0.02268677135385, 0.0082159933431, 0.01133567172189, false, 0, null, 0);

            swNote = (Note)swModelDocExt.InsertStackedBalloon((int)swBalloonStyle_e.swBS_SplitCirc, (int)swBalloonFit_e.swBF_Tightest, (int)swBalloonTextContent_e.swBalloonTextItemNumber, "", (int)swBalloonTextContent_e.swBalloonTextCustom, "Lower text", (int)swBalloonFit_e.swBF_UserDef, true, 2, "Denotation Text"

            );

 

            swModel.ViewZoomtofit2();

 

            // Get whether balloon is a stacked balloon;

            // if so, print the name of the balloon

            if (swNote.IsStackedBalloon())

            {

                Debug.Print("Name of stacked balloon: " + swNote.GetName());

            }

        }

        

        /// <summary>

        /// The SldWorks swApp variable is pre-assigned for you.

        /// </summary>

        public SldWorks swApp;

    }

}