Sweep Overview

Sweep creates a base, boss, cut, or surface by moving a profile (section) along a path, according to these rules:

• The profile must be closed for a base or boss sweep feature; the profile may be open or closed for a surface sweep feature.

• The path may be open or closed.

• The path may be a set of sketched curves contained in one sketch, a curve, or a set of model edges.

• The path must intersect the plane of the profile.

• Neither the section, the path, nor the resulting solid can be self-intersecting.

• The guide curve must be coincident with the profile or with a point in the profile sketch.

For cut sweeps only, you can create a solid sweep by moving a tool body along a path. See Sweep PropertyManager.

You can view the sweep using zebra stripes as you create the sweep. Place the pointer on the sweep, open the shortcut menu, and select Zebra Stripes Preview. If you apply zebra stripes, when you create another sweep, or loft, or add a loft section, the zebra stripes appear. Use the shortcut menu to clear Zebra Stripes Preview.

Sweeps can:

• Use guide curves

• Be created with multiple profiles

• Be created as thin features

To create a sweep:

1. Sketch a closed, non-intersecting profile on a plane or a face.

2. Create the path for the profile to follow. Use a sketch, existing model edges, or curves.

3. Click one of the following:

• Swept Boss/Base on the Features toolbar or Insert, Boss/Base, Sweep

• Swept Cut on the Features toolbar or Insert, Cut, Sweep

• Swept Surface on the Surfaces toolbar or Insert, Surface, Sweep

4. In the PropertyManager:

• Select a sketch in the graphics area for Profile .

• Select a sketch in the graphics area for Path .

5. Set the other PropertyManager options.

6. Click OK .