Sketch Relations in Configurations
You can control the suppression state of sketch relations per configuration.
To suppress or unsuppress sketch relations:
Right-click a sketch in the FeatureManager design
tree, and select Edit Sketch.
Click Display/Delete
Relations
on the Dimensions/Relations toolbar.
In the PropertyManager, under Configurations
(at the bottom of the PropertyManager), select the configurations to which
you want the sketch relations to apply: ,
,
or
(these options are only available if there is more than one configuration
in the model).
NOTES:
You
must select a configuration prior to changing sketch relations. When you
change sketch relations, the change is immediately applied to the selected
configuration.
If
you selected Specify configurations,
you cannot clear the active configuration.
Under Relations,
select the sketch relations to suppress or unsuppress.
-
Select or clear Suppressed.
When Suppressed is selected,
the sketch relation's Information Status
changes from Satisfied
to Driven.
-
Click OK
,
and exit the sketch.
The sketch relation is applied to the selected configurations.
To suppress or
unsuppress sketch relations in a design table:
The column header in a design table
for controlling sketch relations uses this syntax:
$STATE@<sketch_relation>@<sketch_name>
For example, to control the suppression state of the first fixed relation
in Sketch2, the column heading
syntax is $STATE@Fixed1@Sketch2.
The column header
is not
case sensitive.
In the table body cells, type S
for suppressed or U for unsuppressed.
Sketch relations and sketch entities include an assigned
number (such as Fixed1) in the
Display/Delete
Relations PropertyManager.
Example of a design table that controls the suppression state of a sketch
relation:
![](../art_local/design_table_sketch_relations.gif)