Predefined Views
You can use predefined views
like named views to preselect an orientation, position, and scale for
views on a drawing template. You can add the model or assembly reference
later using Insert
Model in the PropertyManager.
You can save a drawing document with predefined views as a document
template.
To insert a predefined view into a drawing:
In a drawing document, click Predefined
View 
on the Drawing toolbar, or click Insert,
Drawing View, Predefined.
Click in the graphics area to place the view.
Set options
in the PropertyManager.
-
Click OK 
.
You can populate the view as you insert
it, or you can populate it later.
You can add Projected Views
to a predefined view. For example, if you insert a front view, you can
project top and right views to create a predefined Standard 3 View.
Projected views are automatically oriented and aligned to the original
view. The projected views act as predefined views.
You can copy and paste predefined views.
To populate predefined views:
Drag.
Drag a model from the FeatureManager design tree of an open part or assembly
document into the drawing document. All available predefined views are
populated.
Insert
Model. Right-click in a predefined view and select Insert
Model. Do one of the following:
In
the Insert
Model PropertyManager, select a model from the Open
documents list, or click Browse
and browse to a model file.
Select
a view containing a model.
In
another window, select the model from the graphics area or FeatureManager
design tree.
The view and all its related views (such as projected views) are
populated when you click OK .
Select or Browse. Select a predefined view. In
the PropertyManager, under Insert Model,
select a name from the Part/Assembly
list of models open in the current session, or click Browse
and browse to a model file. The view and all its related views (such as
projected views) are populated when you click OK
.
