Hide Table of Contents

Adding a Library Feature to a Part

You can add a library feature to a part by dragging the library feature from the Design Library to the part.

You can also drag a library feature and place it on a plane.

To add a library feature to a part:

  1. With the target part open, click the Design Library tab on the Task Pane.

  2. Select Design Library folder .

  3. Browse to locate the library feature you want to place.

  1. Select the library feature from the lower panel, and drag it to the face of the part or plane.

  1. In the PropertyManager, under Configurations:

Once you select the configuration, the PropertyManager adjusts depending on whether the library feature includes references.



If the library part includes references, the following is displayed:

  • Graphics area. A preview window that highlights the first reference to select.

  • PropertyManager. The References group that lists the references required to insert and locate the library feature.


If the library feature does not include references, position the library feature by adding:

  • Dimensions between the library feature sketch and the target part.

  • Relations between the library feature and the target part.

  1. Select each of the edges (or other entities such as planes) on the part that correspond to the edges or other entities highlighted in the preview window.

This positions the library feature.

  1. Click Edit Sketch.

  1. Under Locating Dimensions, click Value to edit the dimensions and re-position the library feature.

  1. Dimension or add relations to the library feature sketch relative to the model to position the library feature.

  1. Under Size Dimensions, select Override dimension values to create a custom configuration.

Under Configurations, Custom configuration is highlighted.

If you selected Link to library part under Configuration, you are prompted to clear the option if you want to specify custom dimensions in this instance.

  1. Click Value to edit the dimensions of this library part.

  2. Click .

  1. Click Finish in the dialog box.

You cannot add a library feature to an assembly. However, while editing a part in the context of an assembly, you can add a library feature to the part.

Provide feedback on this topic

SOLIDWORKS welcomes your feedback concerning the presentation, accuracy, and thoroughness of the documentation. Use the form below to send your comments and suggestions about this topic directly to our documentation team. The documentation team cannot answer technical support questions. Click here for information about technical support.

* Required

Subject:   Feedback on Help Topics
Page:   Adding a Library Feature to a Part
*   I acknowledge I have read and I hereby accept the privacy policy under which my Personal Data will be used by Dassault Systèmes

Print Topic

Select the scope of content to print:


We have detected you are using a browser version older than Internet Explorer 7. For optimized display, we suggest upgrading your browser to Internet Explorer 7 or newer.

 Never show this message again

Web Help Content Version: SOLIDWORKS 2012 SP05

To disable Web help from within SOLIDWORKS and use local help instead, click Help > Use SOLIDWORKS Web Help.

To report problems encountered with the Web help interface and search, contact your local support representative. To provide feedback on individual help topics, use the “Feedback on this topic” link on the individual topic page.